Modeling in Assembly Environment

[CameronA]

I'm trying to create a new component within an assembly and I can't seem to extract geometry or reference any of the existing components. It seems that none of the features on existing components are select-able. What am I doing wrong? I'm sure there must be a way to do this.

I am using NX8.5. Thanks!

 

[jerry1423]

In NX7.5 it is accomplished this is the way:

Assemblies (pull-down) -> Components -> Create new component . . .

I assume it is the same in MX 8.5

Just ask if you have questions beyond what I put down.

 

[RyanVLee]

Your filter selections need to be set to whole assembly not just work part.

You can also wave link the other component to your new component if you want your new model to be driven

Ryan Lee
Mechanical Project Engineer

NX 6.0.5.3
NX 9.0.1.3(Testing)
If you can think it it can be modeled

 

[CameronA]

I did create the new component using Assemblies>components>create new component

I've begun modeling my new component and have it set as the "work part". When I have it set up this way I cannot select any geometry from the other components or create reference geometry (datums) using points from those components.

Filter selection is set to entire assembly. It looks like I do not have a license for WAVE.

What I would like to do is use commands such as extrude using until selected as the end condition to make my my new component match contour of the existing components. Thanks!

 

[RyanVLee]

You can also try to promote geometry instead of wave linking

Ryan Lee
Mechanical Project Engineer

NX 6.0.5.3
NX 9.0.1.3(Testing)
If you can think it it can be modeled

 

[jerry1423]

I've begun modeling my new component and have it set as the "work part". When I have it set up this way I cannot select any geometry from the other components or create reference geometry (datums) using points from those components.

You are right you cannot select the geometry while in the work part, but what you can do is extract curves from those part edges and use those curves as a reference. Those curves will then show up as non-associated curves in that component part ~ and you may eventually want to delete them.

(while the component is selected as the work part)
Insert -> curves from bodies -> extract . . . or you can WAVE link as previously mentioned.

 

[CameronA]

I was able to use promote geometry to get what I needed. Thanks!

Thanks again for the quick help guys. I've only been using NX for just over a year, hopefully I can contribute something here.

 

[JohnRBaker]

For what you want to do, you do NOT need a WAVE 'licence'. The ability to create WAVE linked objects in included with every Assembly license.

That being said I had NO problems whatsoever selecting faces in another Component to use as the 'Until Selected' or 'Until Extended' object when creating an Extrude feature. Also, I had NO problem selecting points or edges in other Components when creating Datum planes in the current Work Part. Of course, the 'Selection Scope' had to be set to 'Entire Assembly' but it works fine. Now these were not created associatively unless I also toggled ON the 'Create Interpart Link' icon immediately to the Right of the 'Selection Scope' item in the Selection bar. If this icon is NOT toggled ON, the interpart objects can still be selected, just that no associative links will be created.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
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