How to make model lines show up on drawing?

[ugguy]

This used to work prior to NX9... Now we have NX9 and... Picture this...

I draw a solid model of a cylinder. Pretend that's the bolt. Then I draw another cylinder. Pretend that's the nut. Then I draw a centerline between the two, kinda like what you might see on an exploded drawing. Your model ends up looking like this... see picture.

Now I want to create the drawing, and I want the centerline to show up on the drawing. But it doesn't... the centerline is not view dependent. It's a model line. Everything is on layer 1 to eliminate confusion.

How do I make that line show up on the drawing?

Thanks

UGGuy!

 

[ugguy]

Here's how the drawing looks...

 

[carlharr]

Hello,

Are you using master model method, or just going straight into drafting?

http://www.jcb.com

NX 8.5 with TC 8.3

 

[ugguy]

Master modeling method.

 

[cowski]

Have you added the line to the reference set used by the component in the drawing file? By default, NX only adds solid and sheet bodies to the Model reference set.

www.nxjournaling.com

 

[SDETERS]

Make sure your Curve and or sketch is part of the Model reference set. Then try toggling the model curves on and off in your view style of your view

I am having a simliar issue in NX8.5. I have contacted GTAC. Our issue is in assemblies, with arrangements. Below is the feedback I got.

"I find a report that said sketch curves are not supported in NX/Drafting. The Problem Report is being converted to an Enhancement Request, but I see that it works in your other arrangements."

 

[ugguy]

@cowski
That was the fix. But the view wouldn't update. However, when I created a new view, all the lines came in as they should.

@sdeters
how do you toggle your model lines on and off?

 

[SDETERS]

(In NX 8.5)Double click your view border. Then go to the hidden line tab. Now there is a toggle in this tab called include model curves.

Per the NX help. "Include Model Curves Applies the hidden color, font and width options to curves contained in the view. This option is especially useful in drawings with wireframe curves or 2D sketch curves.
Note
•For faceted representation views, only faceted topologies participate in hidden line processing. Modeling curves are unaffected by this option.

•This option will not affect splines of degree 1. If you have a degree 1 spline, a workaround is to replace the spline with polylines to obtain hidden line processing.

This is where our problems start. We are using a component part for trace lines per say. We have thirty or so different arrangements, and for one of the arrangements, we have a part that contains sketch curves for our trace lines. This part is being used in our Exploded View arrangement. This part is suppressed in all of the other arrangements. (Explode assembly function does not work for us)

Now when we try to process down this exploded arrangement into our drawing these curves show up if we toggle this include model curves off. But the curves are not hidden by the solids. Now we turn the include model curve option on and these sketch curves do not show up on the drawing anymore. They disappear.

Now I do not know if you can use any of this for your issue or not? But it sounded similar.

A couple more thoughts. Make sure you do a layer visible in view is set to global. ALso do a show all. maybe they go hidden for some reason.

Thanks

Shane