sketch driven pattern-place holes equi-dist along a closed sketch 1

[borsht]

I have a closed sketch, made of 8 segments-4 lines, and 4 radius'(radius' are tangent to lines)-aka "a rectangle with filleted corners". I want to use the closed sketch as the centerline of a pattern of holes, where the centers of holes are equally spaced from each other. I'm not having any luck with sketch driven pattern. It seems to only select 1 of the path segments for the path.

 

[MElam]

Create a "composite curve" from the sketch, then use it for your pattern to follow. This will group them into one entity.

 

[borsht]

here's my tree, extrude1-(rect. plate), CompCurve1 (path), Cut-Extrude2 (hole I want to pattern on path).

Then I tried the curve driven pattern. (see below for parameters.

I get a curvepattern in the list, but no corresponding geometry ( only original hole-cut extrude2) What secret am I missing?





direct 1=compcurve1
#=5
equal spc is checked
curve method:
trans curve=filled
offset=empty
tangent=filled
slign=empty
feature to pattern=cut-extrude2
faces to pattern=empty

Nothing

 

[MElam]

I'm not sure what's wrong. Your settings work for me.

What SP are you on? I'm on 3.0

While editing/moving things around, mine went to only one instance once. But I can not make it happen again. Try deleting the pattern and re-create it.

 

[borsht]

2003 sp5, I tried it again on a different part. It worked a couple of times-depending on the numbers I put in, weird.

 

[CorBlimeyLimey]

Sounds like a glitch ... submit the problem to you VAR &/or SW.

from (the City of) Barrie, Ontario.

Everyone has a photographic memory. Some just don't have film.

 

[MElam]

For 2003 there is an SP 5.1

It does have a fixed SPR (# 192434) "Curve driven pattern will not consistently generate in SolidWorks 2003 SP5.0. Pattern may generate after several forced rebuilds."

If you have a subscription, download 5.1

 

[borsht]

that was it, I loaded the sp5.1 and it was instantly fixed.
thanks