How to: Replace a Draft view 1

[ryandias]

I have a drawing (dft) that is fully dimensioned (hugely detailed), that has to have minor changes in the model.
Is there anyway to reroute the file path from modelRev1 to modelRev2? without losing all the other dimensions?

Kind of like replace file in an assembly?

 

[KENAT]

Are you familiar with revision manager?

There are a number of ways to do this but revision manager is probably best.

Depending on how/if you reply I'll try and give a more detail response.

Ken

 

[ryandias]

I'm not familiar with rev manager.

I have just tired to alter the file outside of solidedge.

I saved the original assembly as a older rev, then saved the new rev as the original (name) assembly.

hoping that the dimensions would not disconnect, but many have. (what i was afraid would happen)

 

[donyoung]

Hi,

another way to change the path is:

- in draft
Main Toolbar --> Edit --> Links
- select the source file entry to be changed
--> click on 'Change Source'

Regardles of the method you choose: in case a geometric
object within the source has changed a dimension might
become detached.

dy

 

[KENAT]

Dy beat me to it. That's how I used to do all my file link management.

Dimensions etc often get detatched but should be fairly easy to repair. At least in the newer versions of SE.

 

[kjoiner]

I would also recommend using Revision Manager to make the changes. Here are the steps:

In the file open window, right click on the draft file and select "open with revision manager". You will see the draft file and below it, the model that drives it.

click on the draft file and then right click and select, "set action to copy". This will place a copy in the right column of revision manager. It will still have the same name, so change the name to something else like adding a "2" or "B" or whatever is your preferred revision increment.

Then go to the file menu and select "perform actions" This will create a copy of the file and the new copy will now show in the left side of revision manager where the original was listed.

If you want to change the model that drives the draft file, then right click on the model listed below the draft file and select "set action to replace" and pick a new model.

Although this sounds a little involved, it is the safest way to make copies and should avoid having detached dimensions. Using save as might lead to broken links.

Using revision manager is very powerful and can also be used to handle more complex efforts such as families of parts. You would only need to go through the detailing process once, and then using the above steps, copy that one file as many times as needed and use the replace function and you now have a bunch of detail drawings with minimal effort.

One other step you could try is to use edit links in the draft file and point to the new model but I still prefer revision manager.

Kyle

 

[donyoung]

Hi,

detached dimensions can't be avoided by either method,
because they are related to the underlying geometry of
the driving part.
Example: the top rectangle's line (edge) is used in
dimensioning and within the driving part you just delete
the line and recreate it (not changing anything else) then
back in draft your dimension will be become detached. The
reason is: the dimension references a part's object that
no longer exist. The recreated line is a new object but that
is not known to the dimension.
The above would not have happened when the dimensioning would
have been done by using the 2 upper endpoints of the vertical
lines because they did not change.

Using the Rev.Mngr. to move/copy/change files will, however,
update all links and other references a part may have und thus
will avoid future trouble. Also a simple example for this:
A folder may hold an assembly consting of 2 parts (same folder
just to simplify it a bit.) Now just in explorer copy that
assembly plus both parts to a different location and just delete
one part at the new location. Upon opening the assembly everything
is fine also 1 part shoud have been missing but it's not.
The reason is: that the copy did NOT update the internal links
and thus the assembly looks into the current folder and finds
1 part but the other is still known by the original path. Upon
save the assembly will update its references. Deleting now
the same part at the old location the assembly will complain about
a missing part when opened

dy

 

[KENAT]

Yeah,

Now I vaguely understand it Rev Manager is the way to go.