How do you merge parts in NX

[bjohnson86]

Hello, I have two different parts in an assembly. How would I merge the two parts so they become one solid part (instead of two separate parts).

-Brandon

 

[JohnRBaker]

First delete one of the Components (just from the assembly, not from your file system) from the Assembly and save the Assembly and close it.

Now open the Part file of the Component you just deleted from the Assembly, go to...

File -> Export -> Part...

...select 'Existing' under 'Part Specification' and select the 'Specify Part' button and browse to and select the other Component Part file that wish to merge the current part file with. Leave the 'Object Selection Scope' set to 'Work Part Only', press the 'Class Selection' button, select the bodies which you wish to merge into the Part you just identified above and hit OK. If you wish that the parametrics (features) be retained and if there are no external (such as WAVE linked geometry or Interpart Expressions) set the 'Feature Parameters' option to 'Retain Internal Parameters' and the 'Expression Transfer Mode' to 'Copy Referenced', and hit OK.

Now close this part and open the one that you were merging into and now you can perform a Boolean 'Unite' to combine the bodies together, if that is the desired end state of this model. Note that when you open the Assembly, the new updated part will be shown, but if there were any Assembly Constraints/Mating Conditions which referenced any edges/faces in the deleted Component, you will need to fix/update them, but you should be good to go.



John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

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To an Engineer, the glass is twice as big as it needs to be.

 

[eex23]

I think it should be easier to use wave links (copying solid bodies).

 

[hudson888]

Wave link and unite will do it as will promote body and unite just so long as the two solids form am manifold intersection.

You can import or export geometry from one part to another if you simply want to combine the designs going forwards.

Best Regards

Hudson

www.jamb.com.au

Nil Desperandum illegitimi non carborundum

 

[JohnRBaker]

WAVE linking will NOT allow the preservation of the features and expressions contained in the part file which was being eliminated if it's NOT Merged into what I assume was intended to be a REPLACEMENT for the two current component parts. The Export -> Part route will also result in a 'cleaner' situation since there will be no need to keep the 'parent' part around for editing if the final goal really was to replace two parts with a single one.

John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

http://www.plmworld.org/museum/

To an Engineer, the glass is twice as big as it needs to be.