Tek-Tips is the largest IT community on the Internet today!
Members share and learn making Tek-Tips Forums the best source of peer-reviewed technical information on the Internet!
-
Congratulations cowski on being selected by the Eng-Tips community for having the most helpful posts in the forums last week. Way to Go!
ELFORCE in Nastran
- Thread starter jsboy
- Start date
jsboy,
The ELFORCE (or FORCE) card generates the nodal forces at the four corners of the 2 dimensional element and/or at the center of the element.
If CENTER is specified, only the force at the center is output which is the average of the nodal forces at the corners of the element. ((C1+C2+C3+C4)/4) with C(N) being the nodal forces at the corners)
If CORNER is specified, the nodal forces at the corners as well as at the center is output.
Hope this helps,
Hombre
The CENTER option is the default, by the way.
The ELFORCE (or FORCE) card generates the nodal forces at the four corners of the 2 dimensional element and/or at the center of the element.
If CENTER is specified, only the force at the center is output which is the average of the nodal forces at the corners of the element. ((C1+C2+C3+C4)/4) with C(N) being the nodal forces at the corners)
If CORNER is specified, the nodal forces at the corners as well as at the center is output.
Hope this helps,
Hombre
The CENTER option is the default, by the way.
jsboy,
Remember that, just like in classical plate theory, the force/moment values are given per unit length, i.e. its not the total force/moment acting on a node. The values are calculated by integrating the stresses over the element thickness.
Erik
Remember that, just like in classical plate theory, the force/moment values are given per unit length, i.e. its not the total force/moment acting on a node. The values are calculated by integrating the stresses over the element thickness.
Erik
- Thread starter
- #4
jsboy,
Be careful because if what you are really after is the total force acting at a node you are much better off in NASTRAN getting it from the grid point forces (GPFORCE). The freebody tool in PATRAN is great for visualizing the grid point force output. Remember that the forces calculated with ELFORCE are element-based values so they are not inherently continuous at the nodes which means they are not going to give you the "true" nodal force, depending on the quality of your mesh with respect to the stress gradient in the region you are looking at.
Hope this makes more sense, let me know if it does not.
Regards,
Erik
Be careful because if what you are really after is the total force acting at a node you are much better off in NASTRAN getting it from the grid point forces (GPFORCE). The freebody tool in PATRAN is great for visualizing the grid point force output. Remember that the forces calculated with ELFORCE are element-based values so they are not inherently continuous at the nodes which means they are not going to give you the "true" nodal force, depending on the quality of your mesh with respect to the stress gradient in the region you are looking at.
Hope this makes more sense, let me know if it does not.
Regards,
Erik
- Thread starter
- #7
- Status
Similar threads
- Locked
- Question
- Locked
- Question
- Locked
- Question
