allow non associative views in nx8.5 1

[uwam2ie]

hi,
where can I find the allow non associative views in nx8.5 in customers default?
TIA

 

[JohnRBaker]

Please define what you mean by "non associative views"? Are we talking about Drafting or something else?

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[uwam2ie]

prior nx8.5 we have had an option to create non accociative view from extracted edges.

 

[JohnRBaker]

So you are talking about Drafting, correct?

OK, here's what happened. No one ever really liked the idea of adding a 3rd option to the 'Extracted Edges' function, that is one that would make a view 'non-associative'. And since many people didn't really understand what this meant we even tried to 'hide' it by requiring that you had to set a special Customer Default item to even make it an option. And then there was the issue that you could ONLY make a view which used Extracted Edges non-associative to start with. For example, if you had created a 'Faceted' view prior to NX 8.5 you couldn't even set the option to make it non-associative since it was not created using Extracted Edges.

Anyway, when we implemented the new Smart Lightweight Drawing view project for NX 8.5 we decided to fix these issues since Extracted Edges was changed radically in NX 8.5. By definition, both the new 'Exact' and 'Smart Lightweight' view are already using extracted edges, period. That's how it works (you'll note that the 'Extracted Edges' item will always be 'checked' AND grayed-out since it's ON by default now).

So how do we now create a so-called 'non-associative' view on your Drawing? Well, that's what that 'Snapshot' option is that you now see in the Drawing view Style dialog right below the 'Extracted Edges' toggle. Toggling that option ON will mean that the view will not update if the Model changes. Note that you will still be able to sketch in a Snapshot view as well as add PMI and you will still be able to edit the view boundary, but the 'picture' will remain unchanged. And you now can make ANY view a Snapshot view, even a 'Lightweight' view (what we called 'Faceted' prior to NX 8.5) as well as 'Exact (Pre-NX 8.5)' views although you will still need to toggle ON the 'Extracted Edges' option before the 'Snapshot' option becomes active. However, for the new 'Exact' and 'Smart Lightweight' (as well as the regular 'Lightweight') the 'Snapshot' option will always be available and you do NOT need to know the secret Customer Default option to make this all work.

Anyway, I hope that explains what we did and why.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[uwam2ie]

thank you John,
very nice detailed information...
regards