×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

FEMAP plate element connectivity

FEMAP plate element connectivity

FEMAP plate element connectivity

(OP)
Ok, does anybody have any idea why my mesh is separating? all the surfaces were joined using a non-manifold add and the meshes seem to line up, but the plates are separating during analysis. What should I check for?







also, is there a command for deleting all orphaned nodes in a model in FEMAP?

RE: FEMAP plate element connectivity

I don't think the blue piece is connected to the orange piece. An easy way to avoid this is to mesh both surfaces in the same command. If you're learning (and want to see/control things) either mesh the surfaces or mesh the edge curves and then eliminate coincident nodes.

You probably have two curves (coincident curves). The two pieces may have different (incompatible) meshes. use element shrink (view/options/tools/shrink = 70%) to see.

If the same mesh use coincident node check (tools/check/coincident nodes) to merge coincident nodes.

To clean up nodes, delete/model/nodes/select all ... it'll delete unused nodes, and won't delete used ones.
You can renumber (modify/renumber/...).

another day in paradise, or is paradise one day closer ?

RE: FEMAP plate element connectivity

(OP)
Thanks RB1957. I deleted my orphan nodes of which I had 150. I remeshed the surfaces at the same time and tried to delete any coincident curves in the model, but got an error that coincident curves can’t be selected on a solid but I don’t have any solids in the model. Of course I ran the analysis and had the same problem. Perhaps that means it’s the coincident curves I haven’t taken care of. Star for how helpful you’ve been

RE: FEMAP plate element connectivity

(OP)
By the way these surfaces were attached perfectly until I increased the loads in the model, then they separated.

RE: FEMAP plate element connectivity

thx for the LPS.

co-incident curves aren't a problem for FeMap ... they're only a problem for us users ! We have to make sure we pick the right ones !! The point is if you load a curve that isn't associated with a surface then I don't think much will happen.

If they're together for one load, they should be together for a higher load. The "only" way they can separate is if they have different nodes. Check for coincident nodes. Check for non-matching element meshes.

Start with a simple model, two surfaces to make an angle.

another day in paradise, or is paradise one day closer ?

RE: FEMAP plate element connectivity

Coincident nodes can be checked using Free Edge display.
First press F6 and set Tools and view style->Free edge and face->Free edge->2..View, draw model.

Then press F5 and select Model Style->Free edge.

Now free edges, where elements not connected with other elements, are highlighted as yellow lines.
Here is two plates before node merging.

And after.

RE: FEMAP plate element connectivity

(OP)
Thank you for the comment karuchan! The first thing I did when I had this problem was check free edges and they were all in logical spots. None where I had my problem. I also ran the coincident merge check and I’m still having the same problem. I must have something uncommon going on here

RE: FEMAP plate element connectivity

Hi
Try this, list two adjoining elements that separate and see if they have two common nodes. If they have and still separate it's strange, but I don't think that is the case.

When you merge nodes, do you use a reasonable tolerance?

From your other post I assume that you are used to a FEM-environment that does this "checking" and "fixing" of meshes automatically. Femap does not du that, now it is your responsibility to check things like this smile.

Good Luck

Thomas

RE: FEMAP plate element connectivity

(OP)
Thanks ThomasH! I know this is easy, but what are the steps I should take to check which nodes are connected to an element in FEMAP? As far as the coincident node merge tolerance I used the default value that FEMAP provided as I am not sure what a reasonable tolerance is.

RE: FEMAP plate element connectivity

Hi

List - Element, pick two that should be connected and check that they have common nodes.

As for the merge tolerance, what would you think is reasonable to catch coincident nodes?

Thomas

RE: FEMAP plate element connectivity

Yes tools/check/coincident nodes has a default value. I have on ocassion input my own value ... like knowing I want 0.2" elements I can increase the value to 0.05" without overly distorting the elements.

But looking at the mesh your nodes should be sufficiently close.

This is why I suggested shrinking the elements to see connectivity.

You can plot with nodes with labels (their number) and see them.

I will also use the List command and use the cursor to pick nodes where I'm interested. Pick nodes untill the crusor leaps away from area of interest.

many ways to skin cats.

another day in paradise, or is paradise one day closer ?

RE: FEMAP plate element connectivity

(OP)
Ok, so I definitely have a free edge where two surfaces should be joining and I think it is due to a coincident curve that I can't get rid of. The curve is NonDeletable, because it is associated with the edge of the surface. I have merged all nodes to a tolerance of 0.016 with my mesh size in most places being 0.5. I have deleted all deletable curves in the model and deleted and re-modeled the surface in hopes of the surfaces joining eachother if drawn in a different way. I'm still getting a free surface where I should not be. What can I try?

RE: FEMAP plate element connectivity

you can manually select the nearby coincident nodes and force their merging.

You can run the coincident node check with "detail list" (instead of "merge") and see how close things are. How do you know 0.016" is grabbing nodes that you want to merge ?

Using element "shrink" is a good way to see these difference.

You can remesh the two surfaces (at the same time) ... maybe this won't work since the surfaces don't share a common curve.

You can mesh all the coincident curves ... but maybe this won't work (if curves are different lengths).

As a last resort, you can move one node to another node's position (modify/edit/node, select node to move, use "on node" as the new location).

another day in paradise, or is paradise one day closer ?

RE: FEMAP plate element connectivity

(OP)
aren't free edges a function of geometry and not nodes though? If I have a free edge I thought it suggested my surface geometry is not connected and something needs to be changed there.

RE: FEMAP plate element connectivity

Hi
I take itat the two adjoining elements did not have two common nodes?

Try to measure the distance between two nodes where there should only be one. Then merge with a tolerance twice that distance.

Thomas

RE: FEMAP plate element connectivity

I'd've thought "free edges" detected that adjoining elements were not joined (ie two sets of nodes along the common boundary.

I think the way FEMap works is that each surface has it's own boundary curves. FeMap seems to be completely happy with coincident curves (as opposed to merging coincident nodes).

In any case, it's the nodes you need to have common between the "surfaces".

another day in paradise, or is paradise one day closer ?

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members! Already a Member? Login


Resources


Close Box

Join Eng-Tips® Today!

Join your peers on the Internet's largest technical engineering professional community.
It's easy to join and it's free.

Here's Why Members Love Eng-Tips Forums:

Register now while it's still free!

Already a member? Close this window and log in.

Join Us             Close