SW Mates

[malis]

I have an assembly im working on and there is a part that is mated to the assembly. The mate says "Inplace(88789<1>,parallel)". This is the only mate for the part and it defines the location of the part. Also the part is not fixed.

What is this mate? How is it created? and how do you modify it?

Thanks

Confused SW user

 

[Nella95]

Were I you (this isn't a hard and fast rule), but I'd blow away that mate. Right-Click on the part|View Mates| - and delete that in-place mate. Use appx 3 mates to totally constrain it. That 'in-place' is very equivalent to the 'fix part' - it takes care of any cherries at that time, but will present problems when other parts are added to the assembly, or when a part is modified, that is mating to your part.

 

[malis]

I plan on doing that, but just more curious as to how you create it.

 

[Nella95]

Many times - the offending 'in-place' mate is created in an assembly.

 

[malis]

Still confused please explain

 

[CorBlimeyLimey]

When you create a part from within an assy, the "in-place" mate is automatically created. This is normal with "Top Down" design.


Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091

 

[malis]

How do you create a part in an assembly?

 

[MElam]

It gets created by working top-down in your assembly. Anytime you use Insert, New Component the first thing the software does is want you to select a face/plane to place the part on. The selected face will end up being the Front plane of the new part.

The inplace mate basically is a mate between the new parts Front plane and the selected face, and ties (or rather projects) the assembly origin to the new part origin which fully defines the location of the part. It does this because creating in-context relations on a part which is freely moving could be a problem.

Leaving the mate there should not be a problem, but a benifit of deleting and remating like Nella stated is you will then have the ability to edit the new part so that it relates to it's own origin and reference planes in a more logical way.

 

[kellnerp]

What is this mate {INPLACE}? How is it created? and how do you modify it?

The Inplace mate establishes a coordinate system for the base sketch in the new part. In other words it tells the part where it is in relation to the rest of the assembly. Keep it if you keep in-context features, and delete it if you remove in-context features.

http://www.engtran.com

http://www.niswug.org

 

[ctopher]

If you delete it, open the part and make sure all geometry is fully defined. The part was created in the assy, so the geometry is defined within that assy. Deleting it will undefine it.

Chris
Systems Analyst, I.S.
SolidWorks/PDMWorks 05
AutoCAD 05
ctopher's home site (updated 06-21-05)
FAQ559-1100
FAQ559-716

 

[CorBlimeyLimey]

How do you create a part in an assembly?

With an assy open, Insert > Component > New Part[/quote].


Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091