Shaded view with lines ?

[Lars1978]

Hi All,

Please see the attachment. In the left view a shaded view is visible. My opinion is that to many lines are visible. I'd like to have the same shaded view as in the model environment.

Can someone please tell me what buttons to push ?

NX 10 mach adv, stand alone draft.

Thanx.

Lars

 

[Lars1978]

This is the file

 

[JohnRBaker]

Is this a drawing of an Assembly? If so, are some or all of the parts created in older versions of NX? If so, did you run the parts through 'refile' for NX 10.0?

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[Lars1978]

John,
This is an assembly completely build in Nx10

Lars

 

[JohnRBaker]

Is there a combination of solid and wireframe curves? In modeling shaded views will hide the wireframe curves but I don't think that's the case with shaded Drawing views.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[cowski]

Do any of the components interfere? Interference can cause some lines to appear or not appear in drafting views. There are some options for drafting views that you can try in the view settings.

Also, try using "examine geometry" to inspect your models. If one or more of the models do not pass the body and face checks, bad things can happen.

www.nxjournaling.com

 

[Lars1978]

John/Cowski,

I tried various options in the styles menu. Did not work

Attached the complete assembly and files.

I'm curious about the solution.

Kind regards,

Lars

 

[Toost]

1) this is not master modeling. The drawing and the assembly is the same file.
This does not affect the drawing in any way. Only a note on the side. The recommended practice is to separate the drawing from the assembly.

2) If you want to remove the hidden lines ( NX10), double click the view, select the line "Hidden lines" to the left, tick the "Process Hidden lines", adjust how you desire the hidden lines to be treated.
i.e change the dashed line to Invisible ( 3:rd option from the top.)
Apply or OK button

Regards,
Tomas

 

[Toost]

3) You can probably delete most of the centerlines in these views , I assume that you have the Automatic Centerline feature ON, which creates this spaghetti of centerlines.
Set the selection filter ( top left) to "Symbol" and drag a rectangle around the centerlines you want to delete.


Regards,
Tomas

 

[Lars1978]

Tomas,

Thx a lot. This helpes.

Strange way setting processing of hidden lins on and then making them invisible

The drawing-model file (stand-alone) is done because i'm still saving for TC

Revisions are more easy to manage this was.

Kind regards,

Lars

 

[Xwheelguy]

Lars,

It's really not strange if you think about it. If you do not check Hidden Lines to be active, then the view will not process them any differently than standard wireframe, just like in modeling. If you choose to process the hidden lines, then you have the ability to control how they are displayed, which includes not displaying them.

Tim Flater
NX Designer
NX 9.0.3.4 Win7 Pro x64 SP1
Intel Xeon 2.53 GHz 6GB RAM
NVIDIA Quadro 4000 2GB