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PART VOLUME LINK 2
- Thread starter jloeff
- Start date
You can link text in a drawing to custom property. Simply click the the "link to property" command (the hand holding the paper with the chain link acrossed it) when making text in the drawing. You have to add the custom property to your model before this works.
IHTH, Scott Baugh, CSWP![[spin]](/data/assets/smilies/spin.gif "[spin] [spin]")
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3DVision Technologies
faq731-376
When in doubt, always check the help
IHTH, Scott Baugh, CSWP
3DVision Technologies
faq731-376
When in doubt, always check the help
-
1
- #3
If you want this calculation done automatically (without using VB), there a little bit more to it...
Create a design table in the model including the dimensions required for this calculation. Then add an additional column labeled $PRP@Volume with the appropriate calculation underneath.
You can add the note then as Scott stated above or insert the string $PRP:"Volume" directly into your note.
In several cases, I have also linked the dimensions from Sheet 1 of the design table to Sheet 2 (and more) for more complex calculations and then linked these results back to additional custom columns on the Sheet 1.
It makes for a very simple down presentation method to show how minor design changes affect the end product because the notes can be included in your model views in addition to you drawings.
One additional thing, if you use the additional sheets in your design table, be sure to go back to the Sheet 1 (you cannot rename this sheet also) before closing or SW will error out.
Good Luck....
Remember...
"If you don't use your head,
your going to have to use your feet."
Create a design table in the model including the dimensions required for this calculation. Then add an additional column labeled $PRP@Volume with the appropriate calculation underneath.
You can add the note then as Scott stated above or insert the string $PRP:"Volume" directly into your note.
In several cases, I have also linked the dimensions from Sheet 1 of the design table to Sheet 2 (and more) for more complex calculations and then linked these results back to additional custom columns on the Sheet 1.
It makes for a very simple down presentation method to show how minor design changes affect the end product because the notes can be included in your model views in addition to you drawings.
One additional thing, if you use the additional sheets in your design table, be sure to go back to the Sheet 1 (you cannot rename this sheet also) before closing or SW will error out.
Good Luck....
Remember...
"If you don't use your head,
your going to have to use your feet."
-
1
- #4
Just to clarify the above, you can add a custom property to your part that parametrically calculates the volume. Go to
File > Properties, click the custom tab.
Type 'Volume' (no quotes) in the "Name:" area.
Click in the "Value:" area to select it for input.
Click the "Mass Properties" button & select "Volume"
Click the "Add" button to finish.
Note that the units are set by the last settings you used under the "Options..." box in the Mass Properties dialogue.
Once you get your custom property defined, you can refer to it in notes or BOMs.
File > Properties, click the custom tab.
Type 'Volume' (no quotes) in the "Name:" area.
Click in the "Value:" area to select it for input.
Click the "Mass Properties" button & select "Volume"
Click the "Add" button to finish.
Note that the units are set by the last settings you used under the "Options..." box in the Mass Properties dialogue.
Once you get your custom property defined, you can refer to it in notes or BOMs.
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