NX 8.5 Strange Items in Assembly Draft 2

[python12]

thread561-362266

I am having the same issue as described at the beginning of the thread above. I am trying to create a simple draft view of the outside of an assembly model, but it shows all kinds of strange items from the inside of the assembly. I believe these items are from sketches in parts somewhere down in the part tree. I cannot get them off of the drawing. I attempted to create a 'reference set' (both in the draft view and in the modeling view) to display just the outline of the assembly in question. While creating the new reference set, just the outer lines of the assembly were selected - the undesired items were left un-selected. But, after creating the new reference set, I could not set is as the current reference set.

I have tried to many other ways to get rid of these unwanted items, but I haven't had any success. Any suggestions? Am I doing something wrong?

 

[ewh]

Master Model?

"Know the rules well, so you can break them effectively."
-Dalai Lama XIV

 

[python12]

...I'm new to this forum. Is that a question or suggestion?

 

[cowski]

Both...
Are you using the master model method (model is a component in the drawing file)? It is currently considered a best practice to do so.

www.nxjournaling.com

 

[python12]

Yes, I am using the master model method.

 

[sammcc]

You can use "show and hide" to toggle what you want to see in your drawings or models eg hide datum planes, sketches etc

 

[python12]

I have already used 'show and hide' to get rid of the the datum planes, and a few other things, but many other items remain that I can't remove.

 

[ewh]

Your reference sets need to be created while in the component(s)(either as displayed part or work part), not with the assembly file as the work part.

"Know the rules well, so you can break them effectively."
-Dalai Lama XIV

 

[SDETERS]

Reference sets need to be created in each individual Part not the assembly. Then you need to set these reference sets per component in your main assembly, plus in all of your sub assemblies and so on. It should be all about reference sets in your parts and then setting these correctly in your assemblies. Does your assembly have any Geometry in it? Look at your part navigator to check to see if you assembly has curves, extrude or extra stuff in it.

 

[cowski]

If you are using the NX default setup, it will automatically create and maintain a reference set in each part called "MODEL". An easy way to make use of this in your assemblies is to start NX and before you open your assembly, go to "File -> options -> assembly load options..."; expand the "reference sets" panel, highlight the "use model" option and use the arrow buttons to move it to the top of the list, press the "save as default" button, and finally "OK" the dialog. Now when NX loads your assembly, it will first attempt to use the "MODEL" reference set (if it does not exist in one of the part files, it will attempt to use the next option in the list until it finds an option that works).

www.nxjournaling.com

 

[python12]

cowski,

I tried what you recommended, but when I go to File -> Options -> Assembly Load Options, I only have the choice of "part versions" or "scope" panels. I do not see the "Load Behavior," "Reference Sets," "Bookmark Restore Options," or "Save Load Options" panels.

I'm not sure if this makes a difference, but I have role set to "Advanced, Full Menus"

ewh & SDETERS,

Is there a quick way to add all the individual parts in an assembly to the model reference set? I am working with a large assembly file (100's of parts) that was created previously by someone else.

 

[cowski]

Click the "gear" icon in the dialog title bar (left side) and choose "show collapsed groups" and/or choose the "More" option. This should get the reference set section to show up.

www.nxjournaling.com

 

[SDETERS]

You should be able to select all of your parts in your part navigator using Shift and Ctrl as you select you components in your assembly navigator. Then you can right click on a component and select replace reference sets. You do not need to do each on individual. Pay special attention not to select your sub assemblies. you will have to expand each sub assembly out select these parts individual also.

Setting your load options like Cowski mention is the more robust way of doing things. Are you using teamcenter?

 

[python12]

Suggestions from cowski and SDETERS worked. Thanks!