Nodal results in to a database on FEmap 2

[JohnHam]

Hi all,
Pulling out what little hair I have left. Just started using Femap, can't say I am impressed everything seems to be listed in places you least expect. Tech support seems very slow and poor , one of those call centre type log your issue and get back etc.
I have a simple problem. I need to take off nodal stresses and shears on node sets preferably put into a table to transfer into excel. All would be well if it was elements stresses as that seems easy to do, but nodal results seem limited to displacements and rotations etc.
What I am trying to achive is take nodal stresses through a section to linearize them for ASME codes.

Shouldn't be hard, could have done it in seconds using abaqus, cant do it in Femap and I've been looking for hours!!

Thanks in advance for a any help

John

 

[NevAlblas]

Hi John,

Maybe you should try selecting List>Output>Summary to data table.
Then in the window fill in "Specified Output Vectors"for Output selection and than for Additional Summary for Selected, you chose the "Nodes" option for nodes.
Then you can choose all the output sets and vectors that you want. This is the only option I know for nodal stress results.

Can you reply if this is what your looking for?

Kind regards

 

[BlasMolero]

Dear JohnHand,
Firs at at assuming you run any NASTRAN flavour (for instant, NX Nastran as I do) under Nastran Output Request you need to ask for Stress elemental results. Then run the NX nastran solver and you will have your results to plot using F5 > Contour plots.

http://files.engineering.com/getfil...8f7-9bc0-ecac7a979f24&file=output_request.png

To conert elemental output to nodal output use "Model, Output, Process" command. Choose "Convert" in the Options section, then choose "60031..Solid Bot VonMises Stress". Click "Add Operation" and then OK. This will create Output Vector 9000000..Avg-Converted Vec 7433 in Output Set 1.

http://files.engineering.com/getfil...996-911a-ebdc81a3edeb&file=process_output.png

Once you have the "converted" output vector (converts elemental output to nodal output), you can simply do an XY Plot vs. Position or any you like (export to excel, etc..).

Best regards,
Blas.

 

[Zigmhount]

Hi JohnHam,

Choose Contour Type: Nodal (in Post Data > Contour Options).
Then choose the Node tool on the Select Toolbar.
When you pick a node on the model, you should see its contour value in the Entity Editor.
If yes, then unlock the Data Table, and every Node you will pick will be added in a row, as well as its properties, coordinates, and Contour Value.
Yo can then easily show or hide columns and copy the table into Excel.

I hope that works and that its what you're looking for...

Cheers
Simon