How to draw a curve in Creo that is defined by an equation?

[samihasamin]

So I want to draw a parabola in Creo that is defined by the equation y= (h/(b^2))*x^2

Basically it looks something like this:

Centroid, Area, Moments of Inertia, Polar Moments of Inertia, & Radius of Gyration of a Parabolic Spandrel (Sub-Parabolic Area)

The reason I am asking this is because I need to manufacture a vessel that has curved edges, but I cannot simply give the equation to the fabricator, I have to give him dimensions, and if I draw the curve in Creo it will show the radius of the curve, but I am not sure how to draw a curve that is a function of an equation. If someone knows then please tell me how

 

[zpaolo]

It should be quite simple with a "curve from equation" where you can write a parametric equation to drive your curve. Check in the datum curve flyout menu

 

[csusie]

You will use the "curve from equation" as zpaolo states. The thing you will have to adapt is you need to write your equation in terms of t. t is an arbitrary parameter which by default goes from 0-1. So for your equation you would need to write it as:
x=t
y=(h/(b^2))*t^2
z=0

I created a parameter "base" and "height" and used in the equation for y.

 

[zpaolo]

And if you want your x from a different range instead of putting

x=t

where x will go from 0 to 1, just put it like

x=xmin+t*(xmax-xmin)

so x will span the range from xmin to xmax

Paolo