How do I add a new thread to hole wizard? 3

[deadeye]

I need to add a 10-36 tapped hole to my model but 10-36 is not available in hole wizard. Can I add it or is there some other option for adding non-standard holes?

 

[APPENG]

I just went through this sort of thing today with another fellow. As of yet I have not found any way too add holes to the hole wizard. I have this very same question in to the guru's at SW. The question another fellow had was if he could add something like and SAE O-Ring port and have available as a hole wizard. what I told him was to model a simple block and place the desired hole geometry on one of its faces. Highlight the hole feature in the feature manager, and save the part as a (.sldlfp) open the feature pallette and double click on the features subdirectory and drag the part into the pallette at this location. now you can drag the part into any part you wish.

Jon

 

[APPENG]

Hold on to this thought.

the hole wizard is run through an access dbase and I am checking into the possibility of modifying the .mdb file... Don't try this till i get back with you!!!!

Jon

 

[SnowCrash]

How lucky do you feel?
You could edit the tables which drive the wizard. Look in your install directory, probably, C:/Program Files/Solidworks/lang/english/
Then open the ansiinch.mdb (or whichever is appropriate)file and open the THRD table. Select 'insert a record' and add the data for your thread. You should add it to the TAP table, too. Actually, which tables you change will depend on how you are using the new tapped hole.
I do not use the wizard tapped hole feature on drawings because it confuses our shop guys to see two diameters on a hole - they don't always understand it is a drill hole and a partial depth tap. I use the drill hole for a given tap size and then a cosmetic thread to show the details.

Oh, yeah, before you modify the file be sure to make a copy for backup.

Crashj 'screw this' Johnson

 

[APPENG]

You ROCK snowcrash....

Except the third table is HCOI and that is for heli-coil threads I htink he needs the one called "TAP"

Jon

 

[APPENG]

Yeah you're right though, it depends a bit on how he wants to use them i guess! I'm voting you a star today!

Jon

 

[deadeye]

This is so I can add a 10-36 tapped hole to a .250 thick chunk of 6061 aluminum. It’s meant to receive a connector. I’ve found the mdb files and the two tables but I don’t (duh?) quite know what to add to the THRD table. The two columns in particular are THD_MINOR and THD_MINORI. I see that apparently THD_MINORI equates to “minor diameter min” but I don’t know where the THD_MINOR is coming from. Anybody know?

 

[SnowCrash]

According to the "fields" table these both mean "Thread Minor", except THD_MINORI is listed as "Thread_Minor".
The difference ranges from about .0014 to .010, roughly. Looking at the screw design tables in Marks Mech Handbook leads me to believe this is related to thread class fits. So "Thread_Minor/THD_MINORI" looks like the correct value for internal threads, and "Thread Minor" is for external threads. My tables do not include the 10-36 thread.

Crashj 'too fine!' Johnson

 

[GREIF]

How about adding more catagories of holes. I would like to add tabs with press fit reams & one with slip fit reams. Can this be done?

 

[APPENG]

Grief,

I am currently working with a couple of tech's from SWX on that very same thing. It's not very straight forward in as much there are several things involved here. The access database, the Solidworks API, the holewizard IDX, and some "canned" sketch profiles. I started this venture because some others have been asking me for custom hole profiles. It turns out that it is not very easy to accomplish. I am working out some things here, and then we shall see if the application can be customized to allow the user to add new profiles and hole types via a wizard of some sort.... if anyone has done anything along these lines, by all means get with me and we can share ideas

Regards,
Jon

 

[vikdayal]

Guys what version of SolidWorks does this thread apply to .... cua in SolidWorks 2004 I cant find the mdb file in the location specified, instead I have found the mdb file in ..Solidworks\toolbox\lang\english\ folder and adding stuff to it didnt add to the hole wizard ... HELP needed !