How do filter elements draw elements in V5

[rallydaz]

I've started using V5 after a pretty flaky course, and finding it frustrating after years on V4.

I am trying to filter out certain generated elements from a view. This could be done on V4 using auxview2 : filter.

Please can someone help?

Cheers

Darren

 

[catiajim]

Individual geometric elements (i.e. Lines and Curves)? Or whole parts?

For individual Geometric Elements, simply Delete them. You can get them back later by doing a Restore Deleted on the view (right click on the view, ViewXX.Object, Restore Deleted). Unfortunately, Restore Deleted brings EVERYTHING back

For whole parts, use Overload Properties (right click on the view, ViewXX.Objext, Overload Properties. Select the part to filter out, EDIT, and tell it to not participate in projections). Unfortunately here, you can only select one part at a time

 

[rallydaz]

Thanks Jim,

I am trying to not show a body. This my first V5 model, and I think my methodology is a bit off. I have used multiple bodies in a part model. I am trying to not generate certain bodies in the drawing.

I have tried your idea, unfortunately the 'overload properties' dialog is greyed out, is this because i'm using a part file not a product?

Cheers for your reply

Darren

 

[Azrael]

Yes overlad properties works on Products

You can choose which bodies you want to show on drawing view by picking the body first then the projection plane

 

[jakey]

Rallydaz,
You can't project individual bodies of a part file.
The philosphy of V5 is, for instance,
If you have 2 pieces of plate that get welded together,
then you model them as 2 individual parts and insert them
in an assembly and constrain them together.
The philosphy being, when creating your design model, you should be building it up exactly how you would make in real life. (ie, individual pieces welded, bolted etc together)
Then when you create your drawing you can use Overload Properties to control what you see in the view.
Unfortunately using Overload Properties only lets you select one part at a time and if you have a large assenbly this can be time consuming.
You can use SCENES to control what you see in views.
You can select assemblies and single parts in the SCENE to
not be shown when you project the drawing views. (Quicker !!)
I have found that if you start to delete elements fron the drawing views the Drawing file size increases dramatically.
So try to avoid deleting too many elements from the views.
But as catiajim said, you can get the deleted elements back
but ALL !!!! of them come back and you have to do it all over again.
Hope this helps,
Jakey

 

[itsmyjob]

Hi,

When you create your view, preselect the bodies you want to see. then select the plane that define the view.

Only selected bodies / open bodies will be projected in CATDrawing.

indocti discant et ament meminisse periti
Eric N.​

 

[catiajim]

While Eric and Azrael's methodolgy may work to get something created initially, I think you will have problems in the long run, as I don't think you will be able to Add or Subtract from that view later.

V5 is designed as a "Mono-Detail" design and drafting system (i.e. one part, one model) and as such, it will work much better when used that way.

As for Jakey's advice on using Scenes, that works great so long as you are not in VPM - we can't save Scenes in the Database :-(

 

[KooKoo]

If it's just a matter of getting something created you could also hide the body before you create the view. If you do this you may also want to lock the view since this view will require an update everytime you Hide/Show other things.

 

[rallydaz]

Thanks for all your advice. It's partically useful at the moment. When you've just done a course and now it's time to learn best practice and methodology.

From now on I will use Products and multiple parts, rather than multiple bodies in a part. Then I can use the 'overload' function.

I will also experiment with 'scenes', as i'm using a file based not a database system.

Thanks everyone.

Darren