Flip Directions in a Design Table? 2

[Matthegreeb]

Happy New Year!

Does anybody know if there is a way to flip the direction of a sheet metal bend in a design table? Actually I suppose the same syntax should also work for flipping an extrude direction.

 

[TateJ]

Is this something you want to control with configurations? If not - I think you're best bet is to disable the design table & edit the sheet metal feature to "flip" it. But wait for better suggestions. I've only played with the sheet metal stuff...

Windows 2000 Professional / Microsoft Intellimouse Explorer
SolidWorks 2006 SP02.0 / SpaceBall 4000 FLX
Diet Coke with Lime / Dark Chocolate
Lava Lamp
www.Tate3d.com​

 

[support69]

Under flange length there is a "Reverse Direction" Click that and it will determine what direction the flange will go.

With a DT you cannot control the direction. You might be able to control with some API.

Regards,

support69

 

[Matthegreeb]

Essentially what i Have is a sheet metal part that is used as drawn and opposite hand. I could mirror the part to achieve the desired result, but thought there must be a way to control the direction of a fold using configurations.

 

[Matthegreeb]

I think I've solved it. I ended up creating a new configuration and supressing the first bend then creating the opposite bend using the original sketch. I still seems a little inelegant to me but has solved the problem.

 

[PaulnKY]

I don't know if you are still looking for an answer, but what i do is to use thickened surfaces or extrusions that are constrained to sketches or planes to get the desired shape. the last step in the piece is "insert bends" which will make it a sheet metal part.

 

[J-C]

Please fill out an enhancement request for this here:

http://www.solidworks.com/pages/services/subscription/Enhancements.html

The more people do it, the better our chances of getting it.

Jason

UG NX2.02.2 on Win2000 SP3
SolidWorks 2005 SP5.0 on WinXP SP2
SolidWorks 2006 SP3.3 on WinXP SP2

 

[neilc78]

I have found that having flanges in parts which are suppressed will cause you problems when you try to flatten the part later for processing. To do what you are proposing I would use a Mitre flange. This way you can draw the flange as a line with an angle. The angle can then be added to the DT. For example to flip you would change the angle from 90 Degree to 270. That should work. The other alternative is to draw the cross section of your part and use base flange to extrude it out. Again, the cross section can be drawn as a line with angles on it that the DT can change.