Tek-Tips is the largest IT community on the Internet today!

Members share and learn making Tek-Tips Forums the best source of peer-reviewed technical information on the Internet!

  • Congratulations TugboatEng on being selected by the Eng-Tips community for having the most helpful posts in the forums last week. Way to Go!

External surface extraction for Assembly.

Status
Not open for further replies.

randomdrafter

Mechanical
Joined
Aug 6, 2012
Messages
43
Location
IN
Any one knows how to extract external surfaces in a assembly.

My requiremnt is to create a Dumb solid for a Engine. [Dont want to show internal features,especially Bore and other details]

 
Hello randomdrafter,

Follow these steps:
[ol 1]
[li]First you have to create a single part from your assembly. When you are in Assembly Design workbench go to Tools -> Generate CATPart from Product... (more about this can be found here_1).[/li]
[li]If everything went well, you should have a CATPart with several bodies. You will need to combine (add) them in Part Design workbench using Boolean operations (more about this can be found here_2).[/li]
[li]Now go to Generative Shape Design workbench and use the Extract feature (more about this can be found here_3). Click on any face of the solid and use Propagation type: Point continuity. You should now have an empty shell of the solid.[/li]
[li]Copy the extracted shell into a new *.CATPart using Copy -> Paste Special... -> As Result (more about this can be found here_4).[/li]
[li]And now you can close the extracted shell to obtain the featureless solid using the Close Surface feature in Part Design workbench (more about this can be found here_5).[/li]
[/ol]

Hope this helps,
Best of luck!


[small]
CATIA v5 — user & trainer
ANSYS — user (beginner)
[/small]
 
TibiX , Thanks for the reply I will try this tomorrow.

Currently I have a single file of entire engine as mentioned in 1st step.

will let you know after trying other steps, as this is a big engine I guess it may take lot of time.
 
Since you have a STEP file you can skip the first two steps...
 
Status
Not open for further replies.

Part and Inventory Search

Sponsor

Back
Top