Creating new Frame members

[jlbmech]

I am trying to create some new frame members, but I am having problems comprehending the instructions from the help section of Solid Edge.

Under the Adding Frame Components to a Local Library section of the help I have problems understanding items 2 and 3.

2. Add a profile point with a defined (what is this)attribute to specify the default handle point for each cross section.

This point specifies the handle point for the frame component cross section, which is the point of the cross section that will be connected to the frame path.

Note: If the attributed point does not exist in the frame component file, the Frames command will default to the centroid of the 2-D cross section.

3. Add an attribute to identify the relative orientation line or edge for the frame section.
This is used to automatically position the frame component relative to the specified frame path. The frame cross section will be automatically rotated so the orientation line will be positioned horizontal to the X axis of the reference plane normal to the path segment and the computed centroid of the cross section will be below the orientation line. (I don't understand any of this)

Is there a simple to follow walk thru out there or can somebody enlighten me.

Thanks



SE v18 SP7 WinXP SP2

 

[fredericmenage]

Hi,

This two points are optionnal. if you don't draw that origin point and that X axis line, SE will default to the center of the section and use the orientation as drawn.
NB: If you want to choose the origin and the X axis, you should draw the point and the segment and give those attributes. (I've never defined manually the origin and orientation so I don't know how to enter the attributes).

Anyway, to do it simply, just start a part, create a protrusion, draw the profile of the section, give a extent (whichever value). Save this frame cross section under the folder Solid Edge Vxx\Frames. NB: you can create your own sub-folder.

Now, when you use the frame command, this new cross section will be available.

Fred

 

[fredericmenage]

OK,

I looked at the help, just below the section you looked at, there is a section called 'adding the frame component'.

This section (steps 2 to 5) explains how to give the attributes to the point and the line so that they are recognized as the origin and the horizontal axis. It uses an executable called FrameComponentsUtility.exe.

Fred

 

[jlbmech]

The problem is when I run the FramesComponentuntility macro I keep getting an error that reads "You must have ONE handle point define...There MUST be only 1"

SE v18 SP7 WinXP SP2

 

[donyoung]

Hi,

as Fred already said: there is no need to use the utility to
define a point but when you do it goes like this.

- after completing your sketch choose 'Point' from the toolbar
and place it where you want your handle point to be
reason: This utility does not recognize 'Endpoints' therefore
you have to define one.

- call the program
- click 'Delete ALL ...' to make sure no Attribute is defined
- click *once* on the point you just defined
- click *once* on that line you would like to have defined
as X-axis

Quit
Return (from sketch)
Finish
Cancel or Select

There is no need to define a protrusion just a sketch will do
Frame will ignore anything else.so just

Save


In fact you can use any part in Frame it will use the first profile
or sketch it finds to built a component

dy