CATVBA : Export Sketch Geometry to Excel 5

Suncad · Oct 30, 2013

Hi there.

I am new to the forum although i already used some tips I found in it thanks to google. But today I need something I didn't found. Hope someone can help me.

What I need is to write a macro to export geometric objects of an active sketch in excel. For example something kind of like this :

Set MyPart = CATIA.ActiveDocument.Part
Set MySketch = MyPart.ActiveSketch

For Each item in MySketch

'get points and lines coordinates

next

I have difficulties to find it out by myself since I am not an advance CATVBA user.

Thanks to anyone that would try to help.

Victor

itsmyjob · Oct 30, 2013

could you copy the sketch to an empty doc and save it as IGES ?

Eric N.
indocti discant et ament meminisse periti

Suncad · Oct 31, 2013

Eric,

Thanks for answering.

I want the macro runable on any sketch, this not mean to be used for a specific one. I can save one example as IGES :
Download IGES

ferdo · Oct 31, 2013

Hi,

What Eric wanted to say is that you can open the igs file with a simple text editor and see all data inside (read before a little bit about igs files structure).

I would avoid to use that file host (warnings and deletion from antivirus software), better upload files directly here with engineering.com, zip file.

If you don't want to use the igs, then you need to create a macro to get all the points in all sketches (eventually name of their parents - lines itself doesn't have coordinates).

Regards
Fernando

https://picasaweb.google.com/102257836106335725208

https://picasaweb.google.com/103462806772634246699/

Suncad · Oct 31, 2013

Okay nevermind I didn't get it

I haven't thought of using the IGES that way. I was hoping being able to program this to go further with it after. Anyway I'm going to learn a bit of IGES structure and I think this is going to work.

Thanks for your help.

Victor

Suncad · Oct 31, 2013

Okay nevermind I didn't get it

I haven't thought of using the IGES that way. I was hoping being able to program this to go further with it after. Anyway I'm going to learn a bit of IGES structure and I think this is going to work.

Thanks for your help.

Victor

itsmyjob · Oct 31, 2013

a start for the one who reads my mind [thumbsup2]

Eric N.
indocti discant et ament meminisse periti

ferdo · Oct 31, 2013

Thank you Eric, is good when peoples can see some other ways to solve problems.

Regards
Fernando

https://picasaweb.google.com/102257836106335725208

https://picasaweb.google.com/103462806772634246699/

AlexLozoya · Nov 7, 2013

Code:

Sub CATMain()


Path = "C:\Alex\Book1.xlsx"

Set Document = CATIA.ActiveDocument

Dim oPart As Part
Set oPart = Document.Part

Dim oBody As Body
Set oBody = oPart.Bodies.Item("PartBody")

Dim oSketch As Sketch
Set oSketch = oBody.Sketches.Item("Sketch.1")


Dim geometricElements1 As GeometricElements
Set geometricElements1 = oSketch.GeometricElements


Set objExcel = CreateObject("Excel.Application")
Set workbook = objExcel.Workbooks.Open(Path)

objExcel.Cells(1, 1).Value = "Name"
objExcel.Cells(1, 2).Value = "Type"
objExcel.Cells(1, 3).Value = "Start Point (X)"
objExcel.Cells(1, 4).Value = "Start Point (y)"
objExcel.Cells(1, 5).Value = "End Point (X)"
objExcel.Cells(1, 6).Value = "End Point (y)"
objExcel.Cells(1, 7).Value = "Radius"
objExcel.Cells(1, 8).Value = "Construction"
objExcel.Cells(1, 9).Value = "Line Type"

Dim Line_test As Variant
Dim Endpoint(3)

Dim Point_test As Variant
Dim point_coords(1)



For i = 1 To geometricElements1.Count

LastRow = objExcel.Range("A65536").End(xlUp).Row + 1

Dim linetype
Select Case geometricElements1.Item(i).GeometricType

Case 0
AA = "Unknown"
objExcel.Cells(LastRow, 1).Value = AA


Case 1 'Axis


AA = "Axis2D"
objExcel.Cells(LastRow, 1).Value = AA

A = geometricElements1.Item(i).Name
B = geometricElements1.Item(i).GeometricType

objExcel.Cells(LastRow, 1).Value = A
objExcel.Cells(LastRow, 2).Value = B


Case 2 'Point

A = geometricElements1.Item(i).Name
B = geometricElements1.Item(i).GeometricType

objExcel.Cells(LastRow, 1).Value = A
objExcel.Cells(LastRow, 2).Value = B

Set Point_test = geometricElements1.Item(i)
Point_test.GetCoordinates point_coords

joe = geometricElements1.Item(i).Construction

EE = point_coords(0) / 25.4
FF = point_coords(1) / 25.4

objExcel.Cells(LastRow, 3).Value = EE
objExcel.Cells(LastRow, 4).Value = FF
objExcel.Cells(LastRow, 8).Value = joe


Case 3 'Line

Dim selection1
Set selection1 = CATIA.ActiveDocument.Selection
selection1.Add geometricElements1.Item(i)
 
A = geometricElements1.Item(i).Name
B = geometricElements1.Item(i).GeometricType

joe = geometricElements1.Item(i).Construction


Set Line_test = geometricElements1.Item(i)
Line_test.GetEndPoints Endpoint


AA = Endpoint(0) / 25.4
BB = Endpoint(1) / 25.4
CC = Endpoint(2) / 25.4
DD = Endpoint(3) / 25.4

objExcel.Cells(LastRow, 1).Value = A
objExcel.Cells(LastRow, 2).Value = B
objExcel.Cells(LastRow, 3).Value = AA
objExcel.Cells(LastRow, 4).Value = BB
objExcel.Cells(LastRow, 5).Value = CC
objExcel.Cells(LastRow, 6).Value = DD
objExcel.Cells(LastRow, 8).Value = joe

linetype = CLng(0)
Set visProperties1 = CATIA.ActiveDocument.Selection.VisProperties
visProperties1.GetRealLineType linetype
 
objExcel.Cells(LastRow, 9).Value = linetype
selection1.Clear

Case 4

AA = "ControlPoint2D"
objExcel.Cells(LastRow, 1).Value = AA

Case 5 ' Radius

A = geometricElements1.Item(i).Name
B = geometricElements1.Item(i).GeometricType

Set Line_test = geometricElements1.Item(i)
Line_test.GetEndPoints Endpoint


AA = Endpoint(0) / 25.4
BB = Endpoint(1) / 25.4
CC = Endpoint(2) / 25.4
DD = Endpoint(3) / 25.4
GG = Line_test.Radius / 25.4
joe = geometricElements1.Item(i).Construction

objExcel.Cells(LastRow, 1).Value = A
objExcel.Cells(LastRow, 2).Value = B
objExcel.Cells(LastRow, 3).Value = AA
objExcel.Cells(LastRow, 4).Value = BB
objExcel.Cells(LastRow, 5).Value = CC
objExcel.Cells(LastRow, 6).Value = DD
objExcel.Cells(LastRow, 7).Value = GG
objExcel.Cells(LastRow, 8).Value = joe


linetype = CLng(0)
Set visProperties1 = CATIA.ActiveDocument.Selection.VisProperties
visProperties1.GetRealLineType linetype
 
objExcel.Cells(LastRow, 9).Value = linetype
selection1.Clear



Case 6
AA = "Hyperbola"
objExcel.Cells(LastRow, 1).Value = AA
Case 7
AA = "Parabola"
objExcel.Cells(LastRow, 1).Value = AA
Case 8
AA = "Ellipse"
objExcel.Cells(LastRow, 1).Value = AA
Case 9
AA = "Spline"
objExcel.Cells(LastRow, 1).Value = AA


End Select
Next i

End Sub

Something to start ...

ferdo · Nov 7, 2013

Hi,

Nice, good to see solution.

Regards
Fernando

https://picasaweb.google.com/102257836106335725208

https://picasaweb.google.com/103462806772634246699/

Suncad · Nov 7, 2013

I will try this to learn a bit how it works.

On my side with the IGES it works great. Not very clean but I use excel as a temporary file to get lines and circles only (what I need) to export it to an ANSYS macro file.

Here is the VBA code (not clean at all but still works !!!)

Code:

Sub IGES_Decoder()

For i = 1 To 20
ActiveSheet.Columns(1).Delete
Next i
Range("A1").Select
Dim oFSO As Scripting.FileSystemObject
Dim oFl As Scripting.File
Dim oTxt As Scripting.TextStream
'Instanciation du FSO
Set oFSO = New Scripting.FileSystemObject
Set oFl = oFSO.GetFile("C:\Users\user1\Desktop\CATSYS\Calibrage\go.igs")
Set oTxt = oFl.OpenAsTextStream(ForReading)
oTxt.ReadAll
ligne = oTxt.Line
Dim tableau()

ReDim tableau(ligne, 162)
Set oTxt = oFl.OpenAsTextStream(ForReading)

With oTxt
    While Not .AtEndOfStream
    
        tableau(oTxt.Line, oTxt.Column - 1) = oTxt.Read(1)
            
    Wend
End With



Dim intFic As Integer

intFic = FreeFile
Open "C:\Users\user1\Desktop\CATSYS\Calibrage\go.txt" For Output As intFic


' *************************
' *****lignes 110 !!!!*****
' *************************
i = 0
j = 0
Dim test As Boolean
test = False

While test = False
i = i + 1
If tableau(i, 73) = "P" Then test = True
Wend
test = False
While test = False
If tableau(i, 1) = 1 And tableau(i, 2) = 1 And tableau(i, 3) = 0 Then
j = i
test = True
End If
i = i + 1
Wend
i = i - 1
nb110 = 0
While tableau(i, 1) <> "S"
If tableau(i, 1) = 1 And tableau(i, 2) = 1 And tableau(i, 3) = 0 And tableau(i, 4) = "," Then
nb110 = nb110 + 1
i = i + 1
Else
i = i + 1
End If
Wend

i = i - 1
'debut = j
'fin = i


Dim doubleligne As Boolean
doubleligne = False


For cpt = j To i
If tableau(cpt, 1) = 1 And tableau(cpt, 2) = 1 And tableau(cpt, 3) = 0 And tableau(cpt, 4) = "," Then
    For co = 1 To 81
        For k = 1 To 80
        If tableau(cpt, k) = "," And tableau(cpt, k + 1) = " " Then
        doubleligne = True
        doublelignenum = k
        
        
        Exit For
        End If
        Next
            
    If doubleligne = True Then
        For k = 1 To 81
            tableau(cpt, doublelignenum + k) = tableau(cpt + 1, k)
        Next
    End If
             
            
    If tableau(cpt, co) <> ";" Then Print #intFic, tableau(cpt, co);
    If tableau(cpt, co) = ";" Then
    Exit For
    End If
    
    Next
    Print #intFic, ""
End If
Next
 nbline = nbline + i - j + 1
 
 
 
' *************************
' *****matrix 124 !!!!*****
' *************************
i = 0
j = 0

test = False

While test = False
i = i + 1
If tableau(i, 73) = "P" Then test = True
Wend
test = False
While test = False
If tableau(i, 1) = 1 And tableau(i, 2) = 1 And tableau(i, 3) = 0 Then
j = i
test = True
End If
i = i + 1
Wend
i = i - 1
nb124 = 0
While tableau(i, 1) <> "S"
If tableau(i, 1) = 1 And tableau(i, 2) = 2 And tableau(i, 3) = 4 And tableau(i, 4) = "," Then
nb124 = nb124 + 1
i = i + 1
Else
i = i + 1
End If
Wend

i = i - 1
'debut = j
'fin = i

doubleligne = False

For cpt = j To i
If tableau(cpt, 1) = 1 And tableau(cpt, 2) = 2 And tableau(cpt, 3) = 4 And tableau(cpt, 4) = "," Then
    For co = 1 To 162
        For k = 1 To 80
        If tableau(cpt, k) = "," And tableau(cpt, k + 1) = " " Then
        doubleligne = True
        doublelignenum = k
        
        
        Exit For
        End If
        Next
            
    If doubleligne = True Then
        For k = 1 To 81
            tableau(cpt, doublelignenum + k) = tableau(cpt + 1, k)
        Next
    End If
             
            
    If tableau(cpt, co) <> ";" Then Print #intFic, tableau(cpt, co);
    If tableau(cpt, co) = ";" Then
    Exit For
    End If
    
    Next
    Print #intFic, ""
End If
Next
 nbline = nbline + i - j + 1
 
 
' *************************
' *****circle 100 !!!!*****
' *************************
i = 0
j = 0

test = False

While test = False
i = i + 1
If tableau(i, 73) = "P" Then test = True
Wend
test = False
While test = False
If tableau(i, 1) = 1 And tableau(i, 2) = 1 And tableau(i, 3) = 0 Then
j = i
test = True
End If
i = i + 1
Wend
i = i - 1
nb100 = 0
While tableau(i, 1) <> "S"
If tableau(i, 1) = 1 And tableau(i, 2) = 0 And tableau(i, 3) = 0 And tableau(i, 4) = "," Then
nb100 = nb100 + 1
i = i + 1
Else
i = i + 1
End If
Wend

i = i - 1
'debut = j
'fin = i



doubleligne = False


For cpt = j To i
If tableau(cpt, 1) = 1 And tableau(cpt, 2) = 0 And tableau(cpt, 3) = 0 And tableau(cpt, 4) = "," Then
    For co = 1 To 81
        For k = 1 To 80
        If tableau(cpt, k) = "," And tableau(cpt, k + 1) = " " Then
        doubleligne = True
        doublelignenum = k
        
        
        Exit For
        End If
        Next
            
    If doubleligne = True Then
        For k = 1 To 81
            tableau(cpt, doublelignenum + k) = tableau(cpt + 1, k)
        Next
    End If
             
            
    If tableau(cpt, co) <> ";" Then Print #intFic, tableau(cpt, co);
    If tableau(cpt, co) = ";" Then
    Exit For
    End If
    
    Next
    Print #intFic, ""
End If
Next
 nbline = nbline + i - j + 1

'COPIE !!
Close intFic
Range("A1").Value = "type"
Range("B1").Value = "x1"
Range("C1").Value = "y1"
Range("D1").Value = "z1"
Range("E1").Value = "x2"
Range("F1").Value = "y2"
Range("G1").Value = "z2"


  With ActiveSheet.QueryTables.Add(Connection:= _
        "TEXT;C:\Users\User1\Desktop\CATSYS\Calibrage\go.txt", Destination:=Range("$A$2"))
        .Name = "Part1_1"
        .FieldNames = True
        .RowNumbers = False
        .FillAdjacentFormulas = False
        .PreserveFormatting = True
        .RefreshOnFileOpen = False
        .RefreshStyle = xlInsertDeleteCells
        .SavePassword = False
        .SaveData = True
        .AdjustColumnWidth = True
        .RefreshPeriod = 0
        .TextFilePromptOnRefresh = False
        .TextFilePlatform = 850
        .TextFileStartRow = 1
        .TextFileParseType = xlDelimited
        .TextFileTextQualifier = xlTextQualifierDoubleQuote
        .TextFileConsecutiveDelimiter = False
        .TextFileTabDelimiter = True
        .TextFileSemicolonDelimiter = False
        .TextFileCommaDelimiter = True
        .TextFileSpaceDelimiter = False
        .TextFileColumnDataTypes = Array(1, 1, 1, 1, 1, 1, 1, 1, 1)
        .TextFileTrailingMinusNumbers = True
        .Refresh BackgroundQuery:=False
    End With
    ActiveWindow.SmallScroll Down:=12
    Range("A1").Select
    Range("H2", "O" & nb110 + 1).Value = ""
'ActiveSheet.Columns(8).Delete
'ActiveSheet.Columns(8).Delete
'ActiveSheet.Columns(8).Delete
intFic = FreeFile
Open "C:\Users\user1\Desktop\CATSYS\Calibrage\go.mac" For Output As intFic
Print #intFic, "FINISH"
Print #intFic, "/CLEAR,NOSTART"
Print #intFic, "/prep7"
Print #intFic, "et,1,beam188"
'Print #intFic, "KEYOPT , 1, 1, 1"
'Print #intFic, "KEYOPT , 1, 2, 0"
Print #intFic, "et,2,combin14"
Print #intFic, "KEYOPT , 2, 1, 0"
Print #intFic, "KEYOPT , 2, 2, 6"
'Print #intFic, "KEYOPT , 2, 3, 4"
Print #intFic, "type,1"
Print #intFic, "MP,DENS,1,8.96e-09, ! tonne mm^-3"
Print #intFic, "MP,EX,1,107000,     ! tonne s^-2 mm^-1"
Print #intFic, "MP,NUXY,1,0.22,"
Print #intFic, "MP,MURX,1,10000,"
j = 0

Print #intFic, "SECTYPE , 1, BEAM, RECT, , 0"
Print #intFic, "SECOFFSET , CENT"
Print #intFic, "SECDATA , 5, 5, 0, 0, 0, 0, 0, 0, 0, 0, 0, 0"
Print #intFic, "SECNUM , 1"

For i = 1 To nb110
Print #intFic, "n,," & Range("B" & i + 1).Value & "," & Range("C" & i + 1).Value & "," & Range("D" & i + 1).Value & ","
Print #intFic, "n,," & Range("E" & i + 1).Value & "," & Range("F" & i + 1).Value & "," & Range("G" & i + 1).Value & ","
j = j + 2
Print #intFic, "e," & j - 1 & "," & j
Next

Dim xnoeud() As String
Dim ynoeud() As String
Dim raid() As String
ReDim xnoeud(nb124)
ReDim ynoeud(nb124)
ReDim raid(nb124)
Print #intFic, "*dim,listnoeuds,," & nb124 & "," & 2
Print #intFic, "n , , 0, 0, 1"

For i = 1 To nb124
xnoeud(i) = Range("E" & nb110 + i + 1).Value
ynoeud(i) = Range("I" & nb110 + i + 1).Value
raid(i) = Range("E" & i + nb124 + nb110 + 1).Value
Next

Print #intFic, "type,2"


For i = 1 To nb124
Print #intFic, "nsel , all"
Print #intFic, "noeud1=NODE(" & xnoeud(i) & "," & ynoeud(i) & ",0)"
Print #intFic, "nsel,u,node,,noeud1"
Print #intFic, "noeud2=NODE(" & xnoeud(i) & "," & ynoeud(i) & ",0)"
Print #intFic, "nsel,all"
Print #intFic, "R," & i & "," & raid(i) & "*2000,0,0,0,0,0,0,"
Print #intFic, "RMORE,0,"
Print #intFic, "REAL," & i
Print #intFic, "e,noeud1,noeud2," & nb110 + 1
Print #intFic, "cerig,noeud1,noeud2,UXYZ"
Print #intFic, "listnoeuds(" & i & ",1)=noeud1"
Print #intFic, "listnoeuds(" & i & ",2)=noeud2"
Next
Print #intFic, "nsel , all"

For i = 1 To nb124
Print #intFic, "nsel , u, Node, , listnoeuds(" & i & ", 1)"
Print #intFic, "nsel , u, Node, , listnoeuds(" & i & ", 2)"
Next
Print #intFic, "numm,node,.01"
Print #intFic, "nsel,all"
Print #intFic, "esel,all"


Print #intFic, " *ask, Noeudchar, ""Charger quel noeud ?"", 1 "
Print #intFic, " *ask, forceY, ""Quelle force en Y ?"", 0 "
Print #intFic, " *ask, forceX, ""Quelle force en X ?"", 0 "
Print #intFic, " *ask, NbNoeudblo, ""Bloquer Combien de noeud(s) ?"", 1 "
Print #intFic, "*dim,Noeudblo,, NbNoeudblo"
Print #intFic, "*do,i,1,NbNoeudblo"
Print #intFic, " *ask, Noeudblo(i), ""Bloquer quel noeud ?"", 1 "
Print #intFic, "D,Noeudblo(i),all,0"
Print #intFic, "*enddo"
Print #intFic, "F,Noeudchar,FY,forceY"
Print #intFic, "F,Noeudchar,FX,forceX"

'Print #intFic, "F,48,FY,100"
'Print #intFic, "F,48,FX,10"
'Print #intFic, "D,14,all,0"
'Print #intFic, "D,30,all,0"
'Print #intFic, "D,58,all,0"




Print #intFic, "/eof"
Print #intFic, "/sol"
Print #intFic, "solve"
Print #intFic, "/POST1"
Print #intFic, "INRES , ALL"
Print #intFic, "FILE,'Calibrage','rst','.'"
Print #intFic, "SET,LAST"
Print #intFic, "SET,FIRST"
Print #intFic, "/PLOPTS,INFO,3"
Print #intFic, "/CONTOUR,ALL,18"
Print #intFic, "/PNUM,MAT,1"
Print #intFic, "/NUMBER,1"
Print #intFic, "/REPLOT,RESIZE"
Print #intFic, "PLDISP , 1"
Print #intFic, "ANDSCL , 30, 0.01"
Print #intFic, "/SHOW,WIN32"
Print #intFic, "/REPLOT,RESIZE"
 

Close intFic
End Sub

loki3000 · Nov 7, 2013

wow, that is a heavy script, synchrotron.
how long did it take you to master vba like this? and do you know any good internet resources for learning it?
(i am interested in catia and excel scripting primarily).

ferdo · Nov 8, 2013

Star from me, I like when I see more and more contributors with interesting solutions [bigsmile]

.

Regards
Fernando

https://picasaweb.google.com/102257836106335725208

https://picasaweb.google.com/103462806772634246699/

Suncad · Nov 8, 2013

Thanks.

I have some VB knowledge from a previous school project. For the rest I use the vb help (F1) and mostly common search on google. I was able to write a massive renaming script for Catia with some search and patience.

Suncad · Nov 8, 2013

Thank you again Alex.

I worked out your code to get it. Now I have a better understanding of the object tree organization of Catia code (by the way, it works fine

).

AlexLozoya · Nov 11, 2013

This is for the constraints...

But i'm on the R20 SP4 and the property "DisplayName" does not work...

With the proper replacements and R20 SP7 or higher should be working fine...

Code:

Sub Leer()

Path = "C:\Alex\Book1.xlsx"

Set Document = CATIA.ActiveDocument

Dim oPart As Part
Set oPart = Document.Part

Dim oBody As Body
Set oBody = oPart.Bodies.Item("PartBody")

Dim oSketch As Sketch
Set oSketch = oBody.Sketches.Item("Sketch.1")

Set objExcel = CreateObject("Excel.Application")
Set workbook = objExcel.Workbooks.Open(Path)

objExcel.Cells(1, 1).Value = "Name"
objExcel.Cells(1, 2).Value = "Type"
objExcel.Cells(1, 3).Value = "1st Element"
objExcel.Cells(1, 4).Value = "2nd Element"
objExcel.Cells(1, 5).Value = "3rd Element"
objExcel.Cells(1, 6).Value = "Dimension"

    Dim oConstraints As Constraints
    Set oConstraints = oSketch.Constraints
    
    
    For i = 1 To oConstraints.Count
    LastRow = objExcel.Range("A65536").End(xlUp).Row + 1
    Set Cst1 = oConstraints.Item(i)
    objExcel.Cells(LastRow, 1).Value = Cst1.Name
    objExcel.Cells(LastRow, 2).Value = Cst1.Type
    
    If Cst1.Type = 1 Then
    
    Set Dime = Cst1.Dimension
    objExcel.Cells(LastRow, 6).Value = Dime.Value / 25.4
    Else
    End If
    
    s = f(Cst1.Type)
    
    If s = 1 Then
    
    Set Dime = Cst1.Dimension
    objExcel.Cells(LastRow, 6).Value = Dime.Value / 25.4
    Else
    End If
    
    
    
    For K = 1 To s
     Dim Ref1 As Reference
    Set Ref1 = Cst1.GetConstraintElement(K)
    
    
    ' Modifications For R20SP7 and higher
    
    s = Ref1.Name ' Delete this line
    
    
    ' Delete the "s" variable and put "Ref1.DisplayName" on the next line
   objExcel.Cells(LastRow, K + 2).Value = s ' Ref1.DisplayName
   
   
   Next K
    
    
    
    
    Next i
    

End Sub


Function f(a)


Select Case a

Case catCstTypeRadius, catCstTypeMajorRadius, catCstTypeMinorRadius, catCstTypeLength

f = 1

Case catCstTypeDistance, catCstTypeOn, catCstTypeConcentricity, catCstTypeTangency, catCstTypeAngle, catCstTypeParallelism, catCstTypePerpendicularity, catCstTypeMidPoint, catCstTypeChamferPerpend, catCstTypeCylinderRadius

  f = 2
  
  Case catCstTypeSymmetry, catCstTypeEquidistance, catCstTypeChamfer
  
  
f = 3

    End Select
End Function

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CATVBA : Export Sketch Geometry to Excel 5

Suncad

Mechanical

itsmyjob

Mechanical

Suncad

Mechanical

ferdo

Mechanical

Suncad

Mechanical

Suncad

Mechanical

itsmyjob

Mechanical

ferdo

Mechanical

AlexLozoya

Aerospace

ferdo

Mechanical

Suncad

Mechanical

loki3000

Mechanical

ferdo

Mechanical

Suncad

Mechanical

Suncad

Mechanical

AlexLozoya

Aerospace

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