Can solidworks be used to designed rolled sections

[gregcon]

I have been using solidworks for various types of general design , and have found it to be a very useful design package , I am no black belt so I would like to know if anyone has used solidworks for the design of rolled sections for example rolled cones silos circular guards , the parts can be made but the problem is to create a flat pattern of the part , as it is not a sheet metal part I can not find a method to achieve this any help would be great .

 

[ctopher]

There is always a way to create something. What are "rolled cones silos circular guards" ??

Chris
Systems Analyst, I.S.
SolidWorks/PDMWorks 05
AutoCAD 05
ctopher's home site (updated 06-21-05)
FAQ559-1100
FAQ559-716

 

[rockguy]

The are some 3rd party plug-ins that can be added to SW for this. SW 2007 is also going to see some sheetmetal enhancements that will allow you to unfold more complex shapes.

Rob Rodriguez CSWP
President: Northern
Vermont SolidWorks User Group

http://www.robrodriguez.com

(updated 1/30/06)
SW 2006 SP 3.0

 

[dezignstuff]

SolidWorks can create a flattenable rolled cone and a flattenable rolled cylinder using sheetmetal. It has to have an open gap. The way to do it would be:

- draw vertical centerline
- draw either vertical line parallel to center for a cylinder or an angled line for a cone
- do a revolved thin feature, but don't go 360 deg, go somewhat less, like 359 deg, leaving a little gap
- under the sheetmetal tools, select Insert Bends, and select one of the edges of the gap as the Fixed Face
- now it is a flattenable cone or cylinder

Does this do it?

 

[CorBlimeyLimey]

SW cannot, at the moment, handle "plastic deformation" of sheet metal parts. i.e. Parts which, using real life processes, would involve stretching or rippling of the material. The material thickness must remain constant for the part to be recognised as a SM part.


Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091

 

[smcadman]

Do you want the cone or the "ring"? Use the "lofted bend" sheet metal tool for either one. I prefer this method because you can also create square-to-rounds, transitions, etc. Basically create 2 parallel planes, and on each of them create the sketch with about a .010 inch gap opening. Now go to Insert > Sheet metal > Lofted Bends and go from there.
Do a search in SW Help for "lofted bend" for examples. Or go to Design Library > Parts > Sheet Metal > Lofted Bends and open a part to see how it was created.

Flores
SW06 SP3.0

 

[ng89]

Just because you are using plastic, or some material other than sheet metal does not mean you can't use the sheet metal commands. They are there just to give you a flat pattern.

Feel free to use the commands, starting with the suggestions above, and change the material properties to anything you'd like.

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[MElam]

CBL is talking about plastic deformation, not a plastic material.

There is one caveat with using the lofted bend command -
because this is a type of plastic deformation, SWx does not calculate the stretch of the material. Adjusting the k-factor will make no difference what-so-ever in the size of the flat.

Most of the time it is "close enough", but we have had problems with two different parts (one lofted and one not) which need a clean weld between them. They will not match up.

 

[Heckler]

Plastic deformation not plastic material. That's funny

Best Regards,

Heckler
Sr. Mechanical Engineer
SW2005 SP 5.0 & Pro/E 2001
Dell Precision 370
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