×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Laminate post process

Laminate post process

Laminate post process

(OP)
I had tried the laminate elements in NX/NASTRAN for Windows (FEMAP). How can I analyse any failure criteria value in this software? How can I plot it?

Irwin

RE: Laminate post process

Hi Irwin,

When l use NASTRAN with laminates l get the forces and moments for the elements where l want to check. NASTRAN gives you directly N/m for the forces and N.m/m for the moments.
These values corresponds to the forces and moments of the laminate.

In order to check the lamina you can use the values of the forces and moments obtained with any software for laminates (the laminator gives good results).

Good luck,

Esteban

RE: Laminate post process

(OP)
The question is: How can I use similar output as in ANSYS? (Results od different type of failure criterias)

Ervin

RE: Laminate post process

Irwin
  I'm running an older version of NASTRAN (CSA), and here is some guidance from the User's Manual, Vol 1, Section 1.3.15, "Composite Material Structural Analysis".  

  "The action required on the part of the user to access layered composite analysis capability is very minimal.  The user must insert the appropriate PCOMP and MAT8 data which describ e the composite laminate into the bulk data deck.  Ply data recovery options are automatically performed in static analysis based on case control keywords of STRESS and FORCE.  Stresses in individual lamina of the laminate, forces on the laminate and failure index tables for composite laminates will be provided in static analysis if STRESS and FORCE case control keywords are present."

  In using CSA NASTRAN, I have found that you need to write the output to the .f06 file in order to recover the ply data.  This means using STRESS = ALL and FORCE = ALL in the case control, instead of STRESS(corner,plot) = ALL.  Then you have to import the analysis results into FEMAP by reading the resulting .f06 file.  Once you read the .f06 file in, you will have the option to plot the ply failure criteria.

  Another suggestion is that if your laminate has a core, you should model the core with brick elements, and the face sheets as composite laminates.  That way, you can recover the XZ and YZ core stresses to compare with core shear allowables.

Regarding the ply failure criteria, you select the failure type on the property card in FEMAP.

Good Luck
J. Vorwald

P.S.  I'd be interested in knowing more about the problem / application you are working on.  

RE: Laminate post process

J.Vorwald,
 You mentioned that "Another suggestion is that if your laminate has a core, you should model the core with brick elements, and the face sheets as composite laminates.  That way, you can recover the XZ and YZ core stresses to compare with core shear allowables."

 I'd be very intersted to learn more about this  - what would you suggest if core is honeycomb material?

 Thanks
 

RE: Laminate post process

Most composite post-processors will give you out-of-plane core shear stresses when you model the plate as a laminate.  If the core is a honeycomb material, you can still input the properties as orthotropic and apply them to the proper layer in your laminate.  When you post-process, you can see the out-of-plane shear in that particular layer.

Garland E. Borowski, PE

RE: Laminate post process

Thanks Garland

RE: Laminate post process

I have modeled Aramid honeycomb core with solid elements (CHEXA) using anisotropic material cards (MAT9).  I specified appropriate values for G33 (Ezz), G55 (Gyz), and G66 (Gzx), and entered small values for G11 (Exx), G22 (Eyy), and G44 (Gxy).  Please make sure that the material orientation is correct for the solids and plate elements, and the same for all the elements.  

RE: Laminate post process

Thanks Vorwald

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members! Already a Member? Login


Resources

eBook - The Future of Product Development is Here
Looking to make the design and manufacturing of your products more agile? For engineering and manufacturing organizations, the need for digital transformation of product development processes just became more urgent than ever so we wanted to share an eBook that will help you build a practical roadmap for your journey. Download Now

Close Box

Join Eng-Tips® Today!

Join your peers on the Internet's largest technical engineering professional community.
It's easy to join and it's free.

Here's Why Members Love Eng-Tips Forums:

Register now while it's still free!

Already a member? Close this window and log in.

Join Us             Close