×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Too many attempts made for this increment in sandwich panel

Too many attempts made for this increment in sandwich panel

Too many attempts made for this increment in sandwich panel

(OP)
Hi everyone
I have a model in abaqus standard, my model is a sandwich panel under in-plane compression and lateral pressure.
I’ve got this error:
Too many attempts made for this increment
and this warning:
Exhausted the contact constraint pool. Cutting back the time increment and redoing the current increment. Other wise, set the environment variable aba_gcont_pool_size to high or a numeric number (1,2,...) with 1 being equivalent to high.
The strain increment has exceeded fifty times the strain to cause first yield at 23 points
Excessive distortion at a total of 6319 integration points in solid (continuum) elements
My Model units is mm, the Young’s modulus and Yield stress in MPa.
also I have Cohesive layer and I used Quads Damage (Damage evolution and Damage stabilization Cohesive is also define for this) and Elastic with traction Type. for Enn and Ess, I did E/t cohesive layer for Enn and G/ t cohesive layer for Ess and Ett.
My step is General and Nlgeom is On. maximum number of increments is 300, initial increment size=0.01, minimum 1e-5.
In Interaction module I used Tie constraint for between cohesive and top layer and core layer. and coupling constraint is shown in below figure.
when I used coupling constraint and chose cohesive layer, my model errors for cohesive layer and I checked visualization module > Node sets > WarnNodeOverContieSlave. then I didn’t choose cohesive layer in coupling constraint. I figured out this error happened because the cohesive Layer was Slave.
my problem did not solve, but I didn’t get this warning again (WarnNodeOverContieSlave).
in Load module, My load is 0.01Mpa, and boundary condition shown in below figure. I define boundary condition with selected reference point for 3 side. for bottom side when I choose cohesive layer I’ve got warning incorrectDOF, so I did not select this layer.
I guess my problem is in coupling or boundary condition, but I don’t know what is it.
Can anyone help me?

RE: Too many attempts made for this increment in sandwich panel

From your description it seems that you use element-based cohesive behavior (cohesive elements). If you are fine with the assumption of zero thickness adhesive layer, try surface-based cohesive behavior (specified via contact interaction with cohesive behavior property). It's easier to define, causes less trouble and solves faster.

You can also try using automatic stabilization in step settings.

I'm not sure what you mean by "coupled" in the picture with boundary conditions. Let's take the left side as an example. It states: UX = UZ = 0, UY = coupled, UR = 0. So coupling is only applied in the Y direction ? How are the remaining directions constrained in such case ? With boundary conditions applied directly to nodes (not via reference point) ? It would be best if you could attach a screen from Load module showing boundary conditions. Or attach the model's files if you can.

RE: Too many attempts made for this increment in sandwich panel

(OP)
I decided to use surface-based cohesive behavior but I can't figure out how to calculate knn, kss and ktt, so I had to use cohesive elements.
in interaction module I used coupling constraint. I coupled in all directions and in boundary condition Ux=Uz=UR0. and applied boundary condition to reference point.
somebody told me don't use tie constraint between layers, is that right?

I also attached my load module and coupling

RE: Too many attempts made for this increment in sandwich panel

Cohesive elements have to be embedded in a model via shared nodes or tie constraints. The latter approach is easier. Here are the steps to do this for 3D model:

a) if your cohesive layer is modeled as solid (finite thickness):
- create a finite thickness cohesive layer and position it properly with respect to the rest of the model, define surfaces for tie constraints
- mesh the parts
- edit coordinates of all nodes in the cohesive layer to make them lie along the interface between parts that are connected with adhesive
- define tie constraint using surfaces created in the first step

b) if your cohesive layer is modeled as shell:
- mesh the parts and create orphan mesh
- offset zero thickness layer of solid elements (check the options to: delete base shell elements, create set for new elements and create top and bottom surfaces)
- define tie constraint using surfaces created automatically in the previous step, check mesh stack orientation first to determine when you should use top and bottom surfaces

RE: Too many attempts made for this increment in sandwich panel

The cohesive layer needs to be aligned with interface (you have to adjust nodal coordinates to make this part flat). You should complete the second to last step of option a) in my previous post.

What’s more, the mesh of the whole model is too coarse in through-thickness direction.

If this doesn’t work, try with explicit solver.

RE: Too many attempts made for this increment in sandwich panel

(OP)
My problem solved.
Thanks for your help

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members! Already a Member? Login


Resources

eBook - Integrating the Engineering Ecosystem
Aras Innovator provides multiple options for integrating data between systems, depending on the scenario. Utilizing the right approach to meet specific business requirements is vital. These needs range from authoring tools, federating data from various and dissimilar databases, and triggering processes and workflows. Download Now
White Paper - Industry 4.0 and the Future of Engineering Education
With industries becoming more automated, more tech-driven and more complex, engineers need to keep their skills and knowledge up to date in order to stay on top of this wave—and to be prepared for the Industry 4.0 future. The University of Cincinnati offers two online Master of Engineering degree programs designed specifically for practicing engineers. Download Now
eBook - The Design Gridlock Manifesto
In this eBook, you’ll learn 6 ways old CAD technology slows your company down and hear how design teams have put those problems to rest. “The Design Gridlock Manifesto” shares first-hand modern CAD experiences from 15 companies around the world. Download Now
White Paper - Comparing Multi-Patterning at 5nm: SADP, SAQP, and SALELE
Self-aligned multi-patterning techniques such as SADP, SAQP, and SALELE are increasingly popular at advanced nodes, but each process has its pros and cons. IMEC and Mentor, a Siemens business collaborated to identify potentially less-obvious process and design limitations and trade-offs between the three SAMP techniques. Learn more in this paper. Download Now

Close Box

Join Eng-Tips® Today!

Join your peers on the Internet's largest technical engineering professional community.
It's easy to join and it's free.

Here's Why Members Love Eng-Tips Forums:

Register now while it's still free!

Already a member? Close this window and log in.

Join Us             Close