×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Difficulties creating mesh!

Difficulties creating mesh!

Difficulties creating mesh!

(OP)
Greetings, I have a simple model in which I am trying to simulate single lap joint of two cold formed sheets (represented as solid elements)connected through a screw (self drilling screw).
I have managed to draw the screw with the threads and also managed to mesh the screw in addition to creating grooves of the self drilling screws in the both sheets, and have meshed the screw well but the issue is with the mesh of the grooves in the sheets. They have many troubles in generating their elements without errors. Up to the moment I have been not able to mesh it properly despite of applying many and different strategies including different arrangement of partitions to isolate the region with troubles to deal with apart from the rest of the plates. I wish if someone has the experience dealing with such complex geometry to advice me and spot the light on any trick that can help me efficiently mesh the plates. the model is attached below.
Thank you in advance.

RE: Difficulties creating mesh!

Is it absolutely necessary to include thread in your model ? In most cases of bolt joint analyses threads are omitted because they are too complex and even if you mesh them correctly, they increase the number of DOFs a lot. There are other ways of modeling bolts and they still can be very accurate. In the newest (2019) version of Abaqus they even introduced enhanced bolt contact capability in Abaqus/Standard that can be used to include the presence of thread without actually modeling and meshing it. But if you still want to include thread geometry in your simulation it will be necessary to make some partitions.

Apart from attached .cae file could you also attach some images showing your geometry and mesh with errors ?

RE: Difficulties creating mesh!

(OP)
Thank FEA way for fast response again ...In fact this joint is a very simple part of a bigger model I will try to solve within the few next weeks. In this large model I will expected to show a full connection details and FE analysis to that connection which includes 34 screws in the same manner of the simple lab joint. I need to study the effect of the threads to this problem. the larger model will be explicitly solved by LS Dyna but after exporting all of its data and mesh details from ABAQUS to LS Dyna as a ".bdf" or Nastran input file that can be exported from abaqus to LS Dyna easily and can be read in LS Dyna by return. I wish the images below can describe the situation. Thank you again.

RE: Difficulties creating mesh!

For the plate I think that the only option to obtain usable mesh is to separate small cylindrical region around the hole and mesh it with tetrahedral elements. Then you can create tie constraint between this region and the remaining part of the plate to avoid problems with non-matching meshes. This thread is even worse than in case of regular bolts since it has curved edges and thus can't be meshed with hexahedral elements.

RE: Difficulties creating mesh!

(OP)
I actually did...but LS-Dyna has some issues dealing with C3D10 elements generated with the tetrahedral meshing technique... I appreciate your help. If there is any way to avoid these tetrahedral elements my problem is gone ... do you have any other tricks to deal with this matter.


I even thought of Hyper Mesh software as an option but still the problem related to the C3D10 solid elements. By the way the treads of the screw itself are meshed with structured technique and hexahedral elements ...the way I maintained the threading in the plates was by subtracting or cutting a screw instance from the plate then adding another screw in stead of the one used in generating the threads surface in the plates.

RE: Difficulties creating mesh!

Maybe different type of tetrahedral element will work in LS-Dyna (there are several kinds available). It's hard to say which one will be compatible in that software. You could also try to mesh this in some external mesher (since Abaqus is not so good in meshing) and then export to Abaqus and LS-Dyna. Maybe other type of elements in Hypermesh will work. This software is probably the best for meshing.

However if you still want to try meshing this thread with hexahedrons in Abaqus, try further partitioning it and reducing element size significantly.

If everything else fails bottom-up meshing is an option to consider.

RE: Difficulties creating mesh!

I don't see a major problem. In the plate use a larger radius for the partition of the center region. Partition the outer area of the plate to get four portions. Mesh the inside with tets and the area around with hex. A/CAE will automatically tell you, that it ties the incompatible meshes together. No need for the user to add the tie manually.

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members! Already a Member? Login


Resources

White Paper - Addressing Tooling and Casting Requirements at the Design Stage
Several of the tooling and casting requirements of a part can be addressed at the design stage. If these requirements are not addressed at the design stage, lot of time is spent in design iteration when the design reaches the die caster. These design issues lead to increase in time and cost of production leading to delay in time to market and reduced profits for the organization. Download Now
White Paper - The Other Side of Design for Assembly
Assembly level constraints need to be satisfied before the design can move downstream. This white paper will go through the various assembly level issues, which need to be tackled by various organizations on a regular basis. Know more about DFMPro, a design for assembly software. Download Now

Close Box

Join Eng-Tips® Today!

Join your peers on the Internet's largest technical engineering professional community.
It's easy to join and it's free.

Here's Why Members Love Eng-Tips Forums:

Register now while it's still free!

Already a member? Close this window and log in.

Join Us             Close