Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Contact analysis between rigid and deformable problem

Contact analysis between rigid and deformable problem

Contact analysis between rigid and deformable problem

Hello, I am a newbie to ABQ, so please have patience with me .
I am modeling contact analysis between rigid and deformable (elasto-plastic steel) body. The problem is axisymetric, the rigid body is wire. The interface is free interface (I used tangential frictionless behavior). When applying load, after certain amount of deformation the deformable body enters the rigid one- which is, obviously, bad analysis. I have tried to use smaller time increment and much finer mesh on the contact surfaces, but none of this seems working. Can any of you advise me what to do?

RE: Contact analysis between rigid and deformable problem

I forgot to add some details of the analysis, I am using ABQ 6.4, the contact is established in Initial step before applying load, the load used is actually displacement. The elements are axisymmetric 8 nodded hexahedral elements. I realy hope someone can help me.
Thank you in advance.

RE: Contact analysis between rigid and deformable problem

Hi janus!!

Please tell me if the deformable boldy penetrates the rigid body near the revolution axis?


RE: Contact analysis between rigid and deformable problem

There is a similar problem of a rigid cylinder contacting a foam surface in manual. Take a look at that. Try using a small amount of friction. In some problems that I have done, it converged better with friction!!. Also maybe start with just the elastic material first and see if it converges and then go to the elastic plastic one. Also look at the message file (file.msg). Is it not converging because of contact (look at severe discontinuty iteration messages) or because of equilibrium not being achieved? Does it abort early on or later in the analysis?

RE: Contact analysis between rigid and deformable problem

Hi, thank you all for the answers.
2psantunes: Yes, the deformable body penetrates the rigit near the revolution axis but it might be as well misleading as there really is a highest deformation in the direction of rigid body.
2harry123456: I will try and I will get back here.

RE: Contact analysis between rigid and deformable problem

2harry 123456: the analysis does not abort at all, it completes successfully, the results are what worries me as they are not realistic.
The elastic material with little friction is better but after larger deformation (comparing to elasto-plastic one) it penetrates again. When using elasto-plastic material with little friction it behaves similarly as described above...
I have looked at the indentation of elastomeric foam with a rigid punch and when I have increased the amount of indentation, the foam also penetrated the punch during the analysis.
Do you think it is a failure of material or failure of analysis or maybe bad material model...
I can not explain, which bothers me a lot.
Thank you again for your kind advices.

RE: Contact analysis between rigid and deformable problem

Hi Janus!

Try to do the following:

Impose Boundary conditions in the nodes placed at the revolution axis of your deformable body (use the edge selection option). If you are imposing the displacement in the direction U3,  define U2=U1=0 at that nodes.


RE: Contact analysis between rigid and deformable problem

If you are carrying out an axisymmetric analysis, how can you be using hexahedral elements?  Structural axisymmetric analyses are 2D with DOF in 1,2 and 6 (rotation about the 3 axis).

As psantunes says, you will still need to impose boundary conditions to any nodes on the axis of symmetry (U1=0)

Also, have you got NLGEOM set in the *STEP option?


RE: Contact analysis between rigid and deformable problem

True, You should have NLGEOM. I dont know if this will help as  much because a rigid body simplifies the analysis-- you might want to try doing the analysis with a deformable body in pkace of the rigid body but put the stiffness of the body really high.

RE: Contact analysis between rigid and deformable problem

Thank you all for your kind advices.
the elements are CAX4R - axisymetric stress elements. I am imposing displacement in the U1 direction , the nodes on the revolution axis are fixed in U1 and UR3 direction,  can freely move along the axis of symetry. Still experiencing the same problem, after certain amount of deformation and when  the Deformation scale factor is set to 1 the deformable body penetrates into rigid one.
 Finally I have used the NLGEOM and it works!!! Thank you very much for cooperation I hope this discussion could save someoene elses time as well.

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members! Already a Member? Login


White Paper - PLM and ERP: Their Respective Roles in Modern Manufacturing
Leading manufacturers are aligning their people, processes, and tools from initial product ideation through to field service. They do so by providing access to product and enterprise data in the context of each person’s domain expertise. However, it can be complicated and costly to unite engineering with the factory and supply chain. Download Now

Close Box

Join Eng-Tips® Today!

Join your peers on the Internet's largest technical engineering professional community.
It's easy to join and it's free.

Here's Why Members Love Eng-Tips Forums:

Register now while it's still free!

Already a member? Close this window and log in.

Join Us             Close