Dimension Location Snap 1

[engmaster]

Ever since I upgraded to SW2007 my drawing dimensions cannot be located just anywhere. They snap to locations at increments of about .50" or so. I have searched thru my settings and unchecked grid & settings but it still does it. Has anyone else seen this?

 

[Theophilus]

Are you using the Smart Dimension or Dimension Xpert feature when placing dimensions?

I searched the options and didn't see anything specific, but remember at the 2007 dog and pony show that an option of this sort was available (doesn't seem to be the default on my machine).



Jeff Mowry

http://www.industrialdesignhaus.com

Reason trumps all. And awe transcends reason.

 

[engmaster]

I am using the Smart Dimension.

 

[smcadman]

This is a feature that SW added; and this is to keep with ANSI standards. The minimum distance from the object to the first dimension is 10 mm (3/8"). The minimum spacing between dimensions is 6 mm (1/4"). These values may increase where appropriate.

Tools > Options > Document Properties > Detailing > Dimensions - "Offset Distances"

SW07 SP2.0

Flores

 

[engmaster]

That is good to know and it could be my problem. However, I have noticed that it only affects radius & diameter dimensions. Also, I changed the offset setting to .030" just to see what would happen and it still snaps to much larger increments.

 

[jdg268]

Is it attempting to snap horizontally or vertically with nearby dimensions?

John Graham CSWP

Mechanical Design Engineer

 

[engmaster]

Yes, along with the other invisible points.

 

[CorBlimeyLimey]

The Dimension Offsets in Tools > Options > Document Properties > Dimensions create "sticky points" to help create consistent dimension spacing. They are also used in some of the functions in the Align toolbar.

 

[SBaugh]

I think the problem is under Tools\Options\System Options\Sketch\Relations/Snapping - Uncheck "Enable snapping"

Regards,

Scott Baugh, CSWP

http://www.scottjbaugh.com

faq731-376

 

[engmaster]

I unchecked "enable snapping" already but it still does it. I have noticed that it may not be snapping in incremental locations as much as it is snapping in incremental angles. In other words, the dimension extension line seems to be held at certain angles.

 

[SBaugh]

Did you uncheck Angle in that same location?

Regards,

Scott Baugh, CSWP

http://www.scottjbaugh.com

faq731-376

 

[engmaster]

Yes, angle is unchecked.

 

[J-C]

I haven't found a way to turn it off for good.....you can override it by holding the "Alt" key.

Jason

UG NX2.02.2 on Win2000 SP3
SolidWorks 2006 SP5.0 on WinXP SP2
SolidWorks 2007 SP2.0 on WinXP SP2

 

[engmaster]

Gilashard: So you are having the same problem?
Are we alone guys or is there anyone else?

 

[CorBlimeyLimey]

Try changing the Dimension Offsets (see my post above) to see if the "snapping" changes accordingly. It does on my systems.

 

[engmaster]

I changed to Dimension Offset to .030 but it still tries to force what seems to be about .50 incremental locations.

Also, the Alt key doesnt it override for me.

 

[sldwkmin]

Try Tools\options\document properties\dimensions and set "radial angle leader snap" to 0. It defaults to 15 degrees in 2007.

Cole M
CSWP, CSWST, CSWI

 

[engmaster]

Thanks sldwkmin. That was it. I dont know why I didnt see that before.

 

[hisrik]

sldwkmin,

great..I have posted this twice ..in other threads..we were all looking into offset distances..but yes your solution is exactly what i was looking for. Thanks a bunch

Mechanical Engineer

 

[hisrik]

By "posted this twice", I meant I posted the question twice...(I just read my own post and I sounded like I posted the solution....!)

Mechanical Engineer