assemble models??

[raymondo1]

Hi
I used True Grid as preprocessor for the meshing of different parts of my geometry and created for each part an input file for abaqus. I want to assemble these now in Abaqus but i am having problems, since i do not have different parts but models. how can i assemble these different models? i thought of merging the different input files to one. can i do so, since the element numbering is the same for the different models? and how can i create the different parts?
any help is highly appriciated

 

[xerf]

Read this first:
ABAQUS Analysis User's Manual
->2.9.1 Defining an assembly

 

[bassmanjax]

Xerf is right - read up on assembly modelling first, I'll add this aswell. You can define a *PART and then use *INCLUDE, INPUT=filename to read in the node and element data from your existing inp files.

Regards

Martin

 

[brep]

A much easier way is to use ABAQUS/CAE.

1. Start with a new database and rename the existing default model to something like "Model-combined"

2. Import your models one by one. (File-Import-Model-*.inp) You will end up with a CAE database that has multiple models in it.

3. Now use the Model-Copy Objects... This will bring up a dialog box where you can choose the parts (etc) that you want to copy from the various imported models to your master model (Model-combined)

4. In your master model you'll now have all the various parts. Instance these into the assembly, then use the assembly module to position the instances

5. Create Steps/Loads/BCs/Interactions etc as required...