×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

ELFORCE in Nastran

ELFORCE in Nastran

ELFORCE in Nastran

(OP)
Could anyone explain to me what is the definition of element force output in Nastran with ELFORCE card? I have to know how it is caluculated. Thanks!!!

RE: ELFORCE in Nastran

jsboy,

The ELFORCE (or FORCE) card generates the nodal forces at the four corners of the 2 dimensional element and/or at the center of the element.

If CENTER is specified, only the force at the center is output which is the average of the nodal forces at the corners of the element. ((C1+C2+C3+C4)/4) with C(N) being the nodal forces at the corners)

If CORNER is specified, the nodal forces at the corners as well as at the center is output.

Hope this helps,

Hombre

The CENTER option is the default, by the way.

RE: ELFORCE in Nastran

jsboy,

Remember that, just like in classical plate theory, the force/moment values are given per unit length, i.e. its not the total force/moment acting on a node. The values are calculated by integrating the stresses over the element thickness.

Erik

RE: ELFORCE in Nastran

(OP)
Erik,
Thanks for your answer but would you please provide more detailed explanation on this? I am not really sure what you are saying here.

RE: ELFORCE in Nastran

He is saying that the force output from NASTRAN for 2D elements is force per unit length (lbs/in for example).  Therefore, you need to multiply the elemental force by the element length.

Hombre

RE: ELFORCE in Nastran

jsboy,

Be careful because if what you are really after is the total force acting at a node you are much better off in NASTRAN getting it from the grid point forces (GPFORCE).  The freebody tool in PATRAN is great for visualizing the grid point force output. Remember that the forces calculated with ELFORCE are element-based values so they are not inherently continuous at the nodes which means they are not going to give you the "true" nodal force, depending on the quality of your mesh with respect to the stress gradient in the region you are looking at.

Hope this makes more sense, let me know if it does not.

Regards,
Erik

RE: ELFORCE in Nastran

(OP)
Thanks Erik!! Very clear!!

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources