How Thin is a Thin Plate?
How Thin is a Thin Plate?
(OP)
In shell analysis (i.e. buckling, etc...), I've always wondered how thin is a thin plate. What is considered a thin plate? What is the definition of a thin plate? This is something I missed asking my profesors back in college. Thanks.





RE: How Thin is a Thin Plate?
corus
http://www.corusresearch.com
RE: How Thin is a Thin Plate?
fsi
RE: How Thin is a Thin Plate?
Your recommended practice neatly demonstrates that FEA is an art as much as a science: those who wished to be uncharitable might criticise such a "modus operandi" on the grounds that it requires precognition of the correct result. Perhaps the substitution of "is" for "will be" might at least go some way to avoiding the suspicion of "circularity".
RE: How Thin is a Thin Plate?
http://www.me.mtu.edu/~bettig/MEEM4405/Lecture12.pdf
It is very difficult nowadays to actually use elements based on thin plate theory. Moreover, many FE packages do not even offer pure plate elements for use in FE analyses, offering only the more general shells instead. I'm not sure the earlier statement suggesting that "A thin plate element can be used if you think that the stress distribution through the thickness will be linear" is entirely accurate, since if this were true you would be able to use it for all linear analyses!
A couple of points about plates:
* Generally speaking, plates are designed only to take transverse loading (loading perpendicular to the plane of the element). Think of a bookshelf: this would be a plate structure.
* A plate structure is one in which curvilinear geometry cannot be accurately captured i.e. use these elements for "flat" structures only.
* Curved geometry would look massively faceted using plates.
* If you're using something like ABAQUS, you wont get the choice of using plates, so just go for something like the S4R (say) which doesn't really care (up to a point) whether your structure is "thin" or "thick", as it will adapt as required.
The best of luck,
-- drej --
RE: How Thin is a Thin Plate?
Unfortunately the design codes which people ultimately refer to don't address the problems of finite element analyses or the correct procedures to be taken. Fortunately those who wrote the design codes recognized the limitations of human ability and built-in sufficient safety margins to make FE results, and the even more dodgey hand calculations with their wild assumptions, safe (we hope).
Thin shell/plates could also be used where the non-linear results (referring to the stress gradient through the thickness) aren't required for assessment. In the latter case I'm thinking of nozzle to shell models which typically use shell elements where the user isn't interested in the peak stresses at the juncture. In general though the 1/20th rule is commonly adopted.
For curved geometry the 8 noded shell elements do capture curvilinear geometry as far as I'm aware.
corus
http://www.corusresearch.com
RE: How Thin is a Thin Plate?
Can depend on mode of failure - elastic vs plastic buckling for example.
For flat plates, NiDI have a free Structural Design Manual for stainless steel (probably similar to Aluminium, but somewhat different to most carbon steels that have a defined yield point). For cylindrical shells, have you looked at books with diamond vs elephant's foot buckling (ie elastic vs plastic)?
Be aware that 'perfect' geometries (as modelled by FEA usually
If this is what you are looking for, let us know and I can probably post some specifics.
Q
RE: How Thin is a Thin Plate?
I gather 1/20 is a good rule of thumb (thanks fsi). I agree with corus about the shell in that ‘stress distribution through the thickness (roughly) linear’ (with good engineering judgment-of course). Yes, I believe that in FEA packages, there is always a certain amount of assumption and compromise. I think, FEM’s are here to aid us in analysis not the substitute. With good engineering judgment, and probably some conservatism (especially in the field of aerospace) a sound engineering analysis can be attained. And there is more to improve in FEA to assess real structures or models.
Drej, thanks for the FEM link. I downloaded some of the lessons to take a look at.
Hope everyone had a good Thanksgiving…
RE: How Thin is a Thin Plate?
- U can assume that a thin shell is thin when thickness is 1/20 of length (i was learned 1/10 but i'ld rather use 1/20). This notion is geometric and not linked to your element size.
- U must check that your problem is linear i-e :
- a normal section of your shell will stay normal after deformation.
- a normal section of your shell will have the same dimension at the end of your analysis
RE: How Thin is a Thin Plate?
I was recently confronted with a honeycomb type structure that was modeled with FEA. The 304 Stainless Steel walls of the structure are only 0.08mm(0.003in) thick. Modelled 10 elements across thickness, indicating a localised over stressed area about two elements deep.
Certainly from a practical point with these thin structures, the stresses, induced, raised etc are started to be driven by physical phenomena ie metallic grain structure, surface affects, surface tension, residual stresses, surface roughness, means of attachment, manufacture inconsistencies etc. These side issues becomes dominant and lessens the practical application of FEM.
Does anybody have some reference or rule of thumb(like the 1/20 of above) as up to what point the FEA and practical test results are still comparable.
RE: How Thin is a Thin Plate?
It is not possible to model 10 elements across the thickness of thin plate elements in FEA. Only 1 element is formulated, used and possible. You could be referring to solid elements which do not apply to this thread.
In reference to your other question about FEA being practical, if all the side effects that you mentioned are modelled in FEA which is possible using nonlinear FEA, practical test results and FEA results are comparable within 1% of each other.
RE: How Thin is a Thin Plate?
Doug
RE: How Thin is a Thin Plate?
regards,
jetmaker
RE: How Thin is a Thin Plate?
RE: How Thin is a Thin Plate?
for thin plates the rule of thumb of 1 plate thickness is a safe one. However the boundary conditions of the model play a factor here as well. A cantilever plate will display linear behavior for deflections up to 15-20 thicknesses. A plate which is fixed on all 4 sides on the otherhand will display nonlinear behavior for deflections on the order of a 1 plate thickness or so. However when in doubt one should always(time permitting of course) run both a linear and nonlinear analysis just be sure.
RE: How Thin is a Thin Plate?
RE: How Thin is a Thin Plate?
Thick shell elements (ie. Bending and shear stiffness included): Thickness between 5% and 10% of the other dimensions.
Using the shear stiffness on elements < 5% thick will not give worse answers. The answers will actually improve. The influence of the shear on the deformation is just small, so that's why you can drop it. If you refine a shell mesh (on a part that shell theory is valid) to the point where the thickness of the element is > 10% of it's other dimensions, then shear stiffness will dominate (or at least be significant) for the element even if it's not dominating the total plate's response. For this reason, add the shear stiffness to help "stabilize" the global stiffness matrix. (you can use much more elements (getting better accuracy) before the solver will have big round-off errors)
RE: How Thin is a Thin Plate?
"A cantilever plate will display linear behavior for deflections up to 15-20 thicknesses."
Is this correct? I thought it will be less than 15-20
RE: How Thin is a Thin Plate?
Consider a steel plate 1 metre long, 100 mm wide, 10 mm thick, fully fixed at one end only. Assume it has a transverse pressure load, so it bends like a cantilever beam. Because this arrangement generates no significant membrane stresses until you get very large deflections, it will behave linearly (or very nearly so), up to quite large deflections. (When I ran this check, it stays effectively linear well beyond 200 mm defelction, or 20 plate thicknesses, if you ignore material yielding and plasticity effects.)
The same plate held at both ends will start to act non-linearly at much smaller deflections, as the membrane stresses can develop at much smaller deflection. (When I ran this model, significant non-linear behaviour was apparent when the deflection reached just 3 mm, or about 0.3 times plate thickness.)
RE: How Thin is a Thin Plate?
I agree . The plate held at both ends, was it also fixed at both ends?
If not will it still show nonlinearity at about .3 times plate thickness or it will be higher?
Thank You
RE: How Thin is a Thin Plate?
My previous comments referred to a test run with the plate being held, but not clamped against rotation, at both ends. Specifically, I found that the non-linear result was within 6.4% of the linear result for deflections up to 3 mm (or 0.3 times plate thickness), and 11.5% at 4 mm deflection.
I have just re-run using the same plate clamped against rotation at both ends as well. In this case, I found that the non-linear result was within 5.7% of the linear result for deflections up to 3 mm, and 10.9% at 4 mm deflection.
That is, the main factor on how non-linear the behaviour is whether membrane stresses can be developed at all, rather than whether the plates edges are clamped against rotation.
RE: How Thin is a Thin Plate?
Thank You
RE: How Thin is a Thin Plate?
RE: How Thin is a Thin Plate?
"What is the definition of a thin plate?"
Generally, it's about using either Mindlin plate theory or the Kirchoff boundary condition to deal with end shear. I suspect that's going to be transparant to the user for modern software but, if you're looking for a more technical definition, that's basically it.
Any good text on plate, membrane, and shell theory will go into more detail.
As to the 1/20 rule - that is the generally accepted guideline. I wasn't going to post at all, but, when I saw you has also asked about the definition of a thin plate, I thought I could point you in the right direction to find the answer.
--
Joseph K. Mooney
Director, Airframe Structures - FAA DER
Delta Engineering Corporation
RE: How Thin is a Thin Plate?
Thanks for any reply,
Guydo
RE: How Thin is a Thin Plate?
You can mesh a 2mm thick plate with 2mm length shell elements and get good results, provided that the "global" dimension lengths are still high (using the 1/20 rule, this would imply a minimum global dimension of 40 mm for your problem).
As others have suggested, the ratio is not "thickness-to-element-size", but rather "thickness-to-global dimension". By "global dimension" I mean the distance between supports, or other constructs which give rise to discontinuities. Although others have suggested 1/20 above, I've also seen 1/10 frequently employed as a rule of thumb.
Brad
RE: How Thin is a Thin Plate?
I was reading the thread intently as I am trying to model, on Ansys, a thin elastomer that will act as plate. Ansys does not seem to have any thin plates, only shell formulations, the closest to a thin plate would be a 2D plane element, but this does not permit pressure to be applied on the plane, just the sides. Would it be alright to model the elastomer in 3D solid elements? The thickness of my specimen is 20 microns, for small deflections one can assume the stress across the z direction will be linear. Any suggestions?
Thanks
Stella