×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Result in different layers?

Result in different layers?

Result in different layers?

(OP)
I use the command:
*SHELL SECTION, ELSET=ALL, COMPOSITE
0.012    ,3    ,MAT1        ,ORI_FRONT
0.016    ,3    ,MAT1        ,ORI_FRONT
0.200    ,3    ,MAT2        ,ORI_FRONT
0.016    ,3    ,MAT3        ,ORI_FRONT
0.200    ,3    ,MAT4        ,ORI_FRONT

How can I view the result for different layers in the Viewer, for instance the stresses? Do I have to specify integration points or something else? Do I have to specify on my output request that I want the results in different layers?

I hope someone can help me, I'm stuck!!

/Pablo

RE: Result in different layers?

Try looking under the field output requests option in Viewer, there might be an option under S (for stress).

RE: Result in different layers?

Hi Pablo

What you need are the different section points of the cross section. In your SHELL SECTION definition you have chosen 3 integration points per layer. So you will find 15 section points for which you can plot the results in the ABAQUS/Viewer.
To identify the section points on which ABAQUS shall store the results, you need to list them in the *ELEMENT OUTPUT option.
If you use another postprocessor than ABAQUS/Viewer, things may be different. FEMAP for instance is not (yet) able to import results on more than two section points per shell element.

Hope this will help.

Rudolf

RE: Result in different layers?

(OP)
Thanks Rudolf!!

How do I specify the different shell section points on the *ELEMENT OUTPUT keyword?

When I look at the Result>filed output>Section points at the moment I only can choose between SNEG or SPOS, I want all the other section points as well!

I hope you can help me some more.

/Pablo

RE: Result in different layers?

*ELEMENT OUTPUT
1,2,3,4,5,6,7,8,9,10,11,12,13,14,15
S,E

This will give the stresses and strains for the section points 1 to 15 (see ABAQUS Keywords Manual page 5.8-1). For the numbering of the section points refer to the ABAQUS/Standard User's Manual, Section 15.6.5.

This is how you can write it into the input file directly. I don't use ABAQUS/CAE.

RE: Result in different layers?

(OP)
Thanks swallow!!

This was a big help, now I know more exactly how I should do this!!

/Pablo

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources