Model parameter input to populate the drawing formats
Model parameter input to populate the drawing formats
(OP)
We've recently (4 weeks) switched from SolidWorks to Pro/E Wildfire and have start parts set up for our models and assemblies with parameters for "drawn by", "part no.", "material" and so on. Our 2d drawing formats have been set up to populate the appropriate fields based on the information the user inputs from the solid .prt or .asm file. Right now, using our default template, the user needs to select "tools", "parameters" and enter these fields. Like most places, there are some designers that are a little lazier than others and tend not to enter this data on their own. It's a little frustrating when you use their part in an assembly and you get no information in your BOM. Is there a setting in config.pro or some other configuration file that can be set so that when someone creates a new part using our companie's standard start part they are prompted to enter the parameters?
Thanks,
Jeff
Thanks,
Jeff





RE: Model parameter input to populate the drawing formats
When I create the drawing and use my company format, it prompts me for the values for the fields in the format.
I just created a new part in Wildfire and added the existing 2001 format and I got the prompts.
"Wildfires are dangerous, hard to control, and economically catastrophic."
Ben Loosli
CAD/CAM System Analyst
Ingersoll-Rand
RE: Model parameter input to populate the drawing formats
Our formats prompt the user as well. I would like to know if there is a way to get these prompts when a user starts a .prt or a .asm
I may use someone's .prt in my assembly before they created the 2d drawing which is where I think you're saying you do it.
Jeff
RE: Model parameter input to populate the drawing formats
I know that in release 2001, you can check a box called "designate" in the model parameter set up dialogue box. What this does, is display the chosen parameter or parameters when starting a new part or assembly. Maybe this is the same in Wildfire?
By the way, how do you like working with Pro/E?.....You almost never hear of anyone switching from SW to Pro/E - it's usually the other way around.
cheers,
JW
RE: Model parameter input to populate the drawing formats
Thanks for the tip but alas, the designate box is checked. There must be a setting hiding somewhere else. I'm going to put a call into PTC and update this thread when/if I get a satisfactory answer.
As far as working with Pro/E, I like it
So far though I think it's great.
Jeff
RE: Model parameter input to populate the drawing formats
Thanks for your comments.
I have never doubted the power of Pro/E. As I have often heard said, "There is almost nothing that Pro/E can't handle - figuring out how to do it is another matter........"
Being the CAD Administrator and a full-time Mechanical Designer, I have often wondered whether there would be less Admin. stuff to do with Solid Works. We have spent many, many hours customizing Pro/E so that it would work well with our company structure. Seeing as we are a small company, I would have rather put those hours into other things.
Thanks again and enjoy the power of Pro
JW
RE: Model parameter input to populate the drawing formats
I'm pretty much in the same shoes as you, mechanical designer/appointed CAD administrator. I too would rather focus on the design work. There is much less administrative stuff with SW. Since we're all new at this Pro/E stuff here at this company, I hope the administrative stuff will calm down after a while (please don't dash my hopes by telling me it won't). Anyway, I got an answer to my question from PTC. The "force_new_file_options_dialog" option in the config.pro file needs to be enabled.
Jeff
RE: Model parameter input to populate the drawing formats
Unigraphics is far easier to set up and customize than Pro/E.
"Wildfires are dangerous, hard to control, and economically catastrophic."
Ben Loosli
CAD/CAM System Analyst
Ingersoll-Rand
RE: Model parameter input to populate the drawing formats
We use this technique for our revision blocks. The revision block header is on the format and then each row of revisions can be added using Table --> Modify row/col --> Add row. If the format is replaced with another format the previous revision block can be moved in to place, since it will remain with the drawing until the table is deleted.
RE: Model parameter input to populate the drawing formats
If you add tables on a drawing which are looking for parameters, ie: model_name, Designer, etc, when a dwg is started and the model lacks these parameters it will ask for a value for same. It will subsequently add the parameters to the model.
Barring this procedure create a mapkey which adds the required parameters and prompts for values.
procadman2
Proe Design & Admin
Mechanical & Aerospace
"You can't build a reputation on something you haven't done."
H Ford