×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

how should I get centroidal values in Quadratic shell elements ?

how should I get centroidal values in Quadratic shell elements ?

how should I get centroidal values in Quadratic shell elements ?

(OP)
Hi All

having Quadratic shell elements, I see that I can obtain centroidal results in Ansys ?

RE: how should I get centroidal values in Quadratic shell elements ?

I had the same problem and have a solution.
I have discussed this problem to death with Ansys and with Bureau Veritas.
Bureau Veritas as well as ABS, DNV and a few other standards base their stress acceptance criteria on centroidal values and their in-house software gives those values by default.
In some software the center value is the basic value stored in the results file and all other values are extrapolate from that value.
Unfortunately, in Ansys elements there is not always a Gaussian point directly at the center. Even when there is, center values are not readily exposed in the Workbench mechanical environment and are not by default stored in the results file. This poses a significant problem when trying to compare results to the acceptance criteria of certain standards.

There are two solutions that have worked for me.
Option 1) In a stress object set the "Position" parameter to "middle". For surface bodies this gives the membrane stress rather than the "top and/or bottom".
In the same stress object set the "Display Option" parameter to "Elemental Mean". This will result in the average stress value of the nodes involved in each element.
Of course this is not the exact value at the center, but for Von-Mises Stress it is acceptably close and Classification design reviewer have accepted this for me.

Option 2) Use the "ETABLE" command (see the help text) in a command object. Using the "AVG" ETABLE option results in the "Store averaged element centroid value". This is the default setting for ETABLEs. By default the results are even labeled "centroid value" and (if the "SHELL,mid" command is given prior to the generation of the ETABLE) they are nearly identical to the results seen in option 1.

I hope this helps.
If you find any better solutions, please let me know.

RE: how should I get centroidal values in Quadratic shell elements ?

(OP)
Thank you so much, sure I will

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources


Close Box

Join Eng-Tips® Today!

Join your peers on the Internet's largest technical engineering professional community.
It's easy to join and it's free.

Here's Why Members Love Eng-Tips Forums:

Register now while it's still free!

Already a member? Close this window and log in.

Join Us             Close