×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Can't Unite Extract Bodies anymore (NX 11)?
3

Can't Unite Extract Bodies anymore (NX 11)?

Can't Unite Extract Bodies anymore (NX 11)?

(OP)
Well,

Just my luck, I'm just starting to develop training content right when we transferred from NX 10 to NX 11 and, of course, I'm having some issues (4 hours on NX 11).

Besides the usual lack of efficiently for a week or so, that comes with new roll-outs, it seems a strong use-case is disabled, which is Uniting an Extract Body to another Body.

I use this often for creating offsets and steps in irregular surfaces, using solids instead of sheets, e.g. Extract Body -> Offset Face in (some faces) -> Offset Face out (other faces) -> Unite -> Shell.

Works perfectly - please tell me this is still an option :(

Regards,
SMO (NX10)

RE: Can't Unite Extract Bodies anymore (NX 11)?

(OP)
Whoa - and Reattach Sketch is greyed out??

Oh boy... anyone?

Regards,
SMO (NX10)

RE: Can't Unite Extract Bodies anymore (NX 11)?

Quote (SMO)

e.g. Extract Body -> Offset Face in (some faces) -> Offset Face out (other faces) -> Unite -> Shell.

Not quite sure what you are trying to accomplish with this but uniting extracted bodies is no problem in NX11


An extracted face is however not a body. And unite/subtract etc only accepts bodies as input. To my knowledge this has never changed.
Faces you can only "unite" with the Sew feature.

Ronald van den Broek
Senior Application Engineer
Winterthur Gas & Diesel Ltd
NX9 / TC10.1.2

Building new PLM environment from Scratch using NX11 / TC11

RE: Can't Unite Extract Bodies anymore (NX 11)?

Regarding the extract body/unite question, check your selection filter during the unite operation. If it is set to something like "curve" or "datum", then NX won't allow you to select a body object (whether extracted or not).

www.nxjournaling.com

RE: Can't Unite Extract Bodies anymore (NX 11)?

(OP)
Hi NutAce,

I'm under the gun at the moment but if you're interested, I can send you a lesson at a later time.
But to quickly elaborate: Extracting a solid, then manipulating that solid, superimposed on top of the source solid, is a way of perfectly and associatively matching, rims and stepped edges on complex, irregular surfaces. Solid body editing can include commands like "General" Pocket (not to be mistaken with regular Pocket) to ensure stepped edges remain Normal to the primary face which creates really clean layering and when you have the base of your shapes completed you can then Unite all solids, add blends and then Shell (examples would be something like a modern dashboard of a car).

But you're right, it appears you can still Unite an extracted body, but from a separate source solid which you can do the fly anyway and not a big deal.

I was hoping to perhaps hear of a setting that might permit what I'm trying to do? Yes, I certain I'm working with solid bodies... BTW, you can combine sheets to solids using the Patch command.

Been on NX 11 now for 8 hours so I'm just experiencing early growing pains.

Thanks for responding.

Regards,
SMO (NX10)

RE: Can't Unite Extract Bodies anymore (NX 11)?

(OP)
Hi Cowski,

That is the way to ensure that you're working with a Solid Body, Sheet Body, Datums, etc. I also remind users of this - on a regular bases actually smile

Thanks for the response but no, this is something different entirely (unfortunately).

I tried to narrow down a possible setting in all the usual places, i.e. Modeling Preferences, Customer Defaults but nothing seem to change this behavior.

Thank again

Regards,
SMO (NX10)

RE: Can't Unite Extract Bodies anymore (NX 11)?

(OP)
Oh wait!

Sorry I got it - I didn't have the "Fixed at Current Timestamp" setting on my Extract feature.

False alarm - that hasn't been set since the new roll-out...

I'm still however, am unable to use Reattach Sketch - it remains greyed-out.

Is that something anyone would know about?

Sorry for combining questions here.

Regards,
SMO (NX10)

RE: Can't Unite Extract Bodies anymore (NX 11)?

For your sketch do a command search for reattach sketch while you are in edit mode in the sketch. Doing it the old way by right clicking on the sketch and going to edit parameters does not work for us anymore. It leaves this reattach sketch greyed our for some reason.

RE: Can't Unite Extract Bodies anymore (NX 11)?

(OP)
SDETERS,

Thank you! Hopefully that's all it is.

Too bad though if the right click option (the only way I typically do it) is permanently disabled?

If so, you would think it would be removed all together.

Regards,
SMO (NX10)

RE: Can't Unite Extract Bodies anymore (NX 11)?

One more thought, Check the Time Stamp setting on the extract.

CSBK

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources