INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Jobs

Analysis of Frame bolted on trailer

Analysis of Frame bolted on trailer

(OP)


Hi everyone,
I'm working on performing some static analysis on the frame shown in the picture.
Can you guys assist me in pick the correct constraint for the bolt holes ?
Also, which constraint will be suitable to represent the contact between the trailer and the frame ?

Thanks!!!

RE: Analysis of Frame bolted on trailer

(OP)
The post is not coursework or project. We are during summer break right now, I am simply learning the software package ANSYS. Would you be able to help with the small question I asked?

RE: Analysis of Frame bolted on trailer

(OP)
Thanks Jeff!
Do you have a reason why I wouldn't be able to use a cylindrical support on the bolt holes?
Also this framing will be modeled to rest on a flat surface, which constraint will be fit that condition ? I was thinking on using a frictionless support (Applies constraint normal to the surface selected).

RE: Analysis of Frame bolted on trailer

Cylindrical support allows translation along length of joint (axial movement). Nuts & bolts prevent translation in this direction.

Yes frictionless contact is the easiest to do. Don't bond it because then your bolt holes won't take tension/shear force that you would expect them to.

On a side note, as you learn ANSYS or any other FEA package, think about your mesh and how well it converges to a steady state solution. Read these two articles to understand how to apply validation, verification and mesh convergence in FEA

https://www.xceed-eng.com/finite-element-analysis-...

https://www.xceed-eng.com/finite-element-analysis-...

Jeff
Pipe Stress Analysis Engineer
www.xceed-eng.com

RE: Analysis of Frame bolted on trailer

(OP)
Splendid!
Great links, I am aware of how important the meshing is. Do you have any book recommendations that address these factors ?

Also,
I will try the Revolute for the bolts hole. Do you have a better recommendation on how to model a surface contact (Contact between frame and flat surface) ?

Thanks!!!

RE: Analysis of Frame bolted on trailer

As was said before, frictionless support is not able to open in Ansys in which case bolt holes would not take as much tension force as in reality. Revolute joints in bolt holes are sufficient
to constrain the model, in my opinion.

For a more detailed analysis, the lower surface should also be modelled. Then you could use nonlinear surface-to-surface contacts (frictionless or frictional) which would allow opening.

RE: Analysis of Frame bolted on trailer

Belisario_G

Easiest way to do mesh independence is plot it yourself. Just pull on model in 1 direction, and record deflection. Then remesh to a finer mesh, pull, and record deflection. Plot deflection vs. number of elements, Eventually you will get to a point where adding elements has no appreciable effect on stress. I have a plot of this in blog post mentioned in previous post

You also want to do something like this at your connections (areas of high stress intentsity). Keep remeshing these areas and monitor stress (such as Von Mises). Eventually localized stresses should level off. Then you know you have a good mesh.

ANSYS also has tools to help you. In the tree on the left hand side (of workbench) click on Mesh. Then in the details window (below) click on Display Style and choose element quality. With element quality ranging from 0 (bad) to 1.00 (best) ANSYS will tell you areas of the mesh that are bad and may need a finer mesh.

Also Surface contact is the "true way" to model this configuration. If you wanted to remove contacts you could apply supports (Zero Displacement) to base plates you expect to be in compression and apply revolute joint to the bolt on the plate subjected to tension. Its an approximation, but gets you out of contact space. You just want to make sure that:
1. Tension forces act at the bolt hole only (not over entire plate)
2. Compression forces act across entire surface of plate
Jeff

Jeff
Pipe Stress Analysis Engineer
www.xceed-eng.com

RE: Analysis of Frame bolted on trailer

You could take a look into "compression only" support. This might achieve the points 1 & 2
mentioned in the post above.

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources


Close Box

Join Eng-Tips® Today!

Join your peers on the Internet's largest technical engineering professional community.
It's easy to join and it's free.

Here's Why Members Love Eng-Tips Forums:

Register now while it's still free!

Already a member? Close this window and log in.

Join Us             Close