×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Delete curve in assembly

Delete curve in assembly

Delete curve in assembly

(OP)
Hi all,

Don't know if this is possible but i have an assembly and used assembly cut, and synchronous modelling, i have 'deleted' the face of a hole but i am stuck with the 'thread' curve, is there any way i can delete this curve within the assembly as it is no longer needed, or is my only option to 'hide' them?
Thanks
James

RE: Delete curve in assembly

Since those 'curves' are actually part of the Hole features in the Components, I suspect that the only practical solution is to Hide them.

John R. Baker, P.E. (ret)
EX-Product 'Evangelist'
Irvine, CA
Siemens PLM:
UG/NX Museum:

The secret of life is not finding someone to live with
It's finding someone you can't live without

RE: Delete curve in assembly

If you want to get rid of the hole, why not delete the hole feature from the component part file?

www.nxjournaling.com

RE: Delete curve in assembly

(OP)
Thanks, yeah i have hidden them at the moment, didn't know if there was a way around it

The reason for doing it this way is because i have 2 similar components, part A and part B, the difference between them is that part B has less holes but uses the same base as part A but they need to be updated together, so instead of having 2 separate model they both work of part A model and then i use synchronous modelling on part B to remove the un-needed holes. Does that make sense?

Regards

James

RE: Delete curve in assembly

Here's an alternative: you could model part B (the one with less holes), then wave link the body into part A and add the other required holes in the part A file. Both will update when part B is edited and part B won't have the unnecessary holes.

www.nxjournaling.com

RE: Delete curve in assembly

There's another thing that you might wish to try.

Open the detailed part file and then edit the Reference Set and explicitly deselect the offending curves. In that way, they should not appear when the Component part if added to an Assembly as long as you use the Reference Set that you just edited/updated.

John R. Baker, P.E. (ret)
EX-Product 'Evangelist'
Irvine, CA
Siemens PLM:
UG/NX Museum:

The secret of life is not finding someone to live with
It's finding someone you can't live without

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources