override position and deformable part in one reusable assembly
override position and deformable part in one reusable assembly
(OP)
Hi All,
I have a question. I'm engineering a conveyor with supports to the ground. This support consist of various parts (aka an assembly).
The conveyor is not horizontal so each support has to have it's own length. (see attachment)
Except for the variation in length the support is the same. I'm thinking about using override position for the connecting lips and make a deformable part for the part witch changes length.
Does anybody have a good example ?
Kind Regards,
Lars
Lars
Solid Edge
Inventor
NX10.0.3.5 native
I have a question. I'm engineering a conveyor with supports to the ground. This support consist of various parts (aka an assembly).
The conveyor is not horizontal so each support has to have it's own length. (see attachment)
Except for the variation in length the support is the same. I'm thinking about using override position for the connecting lips and make a deformable part for the part witch changes length.
Does anybody have a good example ?
Kind Regards,
Lars
Lars
Solid Edge
Inventor
NX10.0.3.5 native





RE: override position and deformable part in one reusable assembly
I mean how many variations
I their are a few say 3 5 variations
I will make 3 5 supports subassemblies
It's easy after making one do save as
And make the variations
RE: override position and deformable part in one reusable assembly
RE: override position and deformable part in one reusable assembly
unlimited variations because we use this support a lot. I like to add the support and then constrain the bottom of the leg to the floor the top of the leg to the conveyor.
SDETERS
Ok you say when making a bunch of solid bodies in one component with the reuse library. Does anybody know how if the deformable part thing works ?
Kind regards,
Lars
Lars
Solid Edge
Inventor
NX10.0.3.5 native
RE: override position and deformable part in one reusable assembly
Yes deformable part thing works
in menu tools choose define deformable part
then choose the part to be deformed
and then choose the length expression to be changed when you bring the part to the assembly
and go thru all the pages and finish
Then when you add the part to the assembly and after mating the part in place
you get a dialog with the length expression set it as you want
and you can use repeat to facilatate the work
Works but not easy if you have many supports
RE: override position and deformable part in one reusable assembly
Open the part to be deformed and then choose tools ==>> define deformable part
and continue as abouve
RE: override position and deformable part in one reusable assembly
Lars
Solid Edge
Inventor
NX10.0.3.5 native
RE: override position and deformable part in one reusable assembly
I think no because the define deformable part works only
on part features such as extrudes sketches or any object on the part navigator
You can try to mix in the subassembly part navigator features that afect the change the lengte
So your subassembly cosist of features and components
RE: override position and deformable part in one reusable assembly
Sory the above is thru but not for your question
I tried what you mean and that not works because all subassemblies will be deformed the same
So you can try the mix as in the previuos post or build the subassembly as one part
RE: override position and deformable part in one reusable assembly
Lars
Solid Edge
Inventor
NX10.0.3.5 native
RE: override position and deformable part in one reusable assembly
We use teamcenter. Our goal was not to have million different part numbers, for each different length of extrusion or shape, in all of our assemblies. We originally went with deformable parts but it just did not work for us. We call this technique using a weldment.
So we modeled our shape with the coordinate systems at the ends to control the lengths, and which in turn modifies the attributes in the "solid body" to our cut lists.
What We did is use reusable object command with the "body" option toggled on in NX to define this reusable object we modeled above.
We set up expressions with sketches, coordinate systems, or what have you in a new part. We drag and drop these reusable parts into the model from the reusable library into this new part. Then we use the three coordinate systems that are in the usable part, to place the reusable part into our model. In the History tree they are named Base (Which defines start point) Base end angle (controls if you want to miter the start end) End length and Angle. (Controls the length and angle of the end of the shape.)
We also set it up with the coordinate systems to define the cut lengths in the solid body attributes. Imagine the coordinate systems with the solid body being put onto a miter saw and cut. So we have angles, lengths in the solid body attributes which automatically will spit into a special cut list. There is a special way of getting this into your 2D drawing parts list. I can supply the drawing if you would like this also.
Kind of hard to explain, but hopefully this gives you an idea of how we accomplished this. Maybe there are some other or easier ways of doing this. Once you set this up and you have Product Template studio, you can modify this through Product template studio instead of through expressions.
Also once you get a model set up, it is really easy to modify an existing one to get a new weldment
RE: override position and deformable part in one reusable assembly
Thank you for the quick reply. I've seen the file. What I see is a part file, not an assembly.
The thing you mention above is this strictly for a part file or can it also be an assembly with the 'leg' parts changing in length ?
Kind regards,
Lars
Lars
Solid Edge
Inventor
NX10.0.3.5 native
RE: override position and deformable part in one reusable assembly
You can also have different components in this file also. But the point of doing this is having different length extrusions, steel shapes as solid bodies not components.
So our assembly looks like this.
Assembly Station Main Assembly (Torque tools, Electric Boxes and Weldment sub assembly)