Coordinate System Symbol in Drafting
Coordinate System Symbol in Drafting
(OP)
Is it possible to place a symbol on a drawing that shows the parts coordinate system? In some cases having the coordinate system show up at the origin would be desired but in some cases I just want to be able to place a symbol that orients and labels the coordinate system of that view. Many times placing that symbol near the view is more legible then at the origin.
I'm using NX 8.5 with the master model concept. I was able to add a datum coordinate system to the drawing "assembly" so that is shows up in all views of the drawing. The issue with that is it shows up in all views, shows up only at the origin and the labels didn't show when printed.
I'm using NX 8.5 with the master model concept. I was able to add a datum coordinate system to the drawing "assembly" so that is shows up in all views of the drawing. The issue with that is it shows up in all views, shows up only at the origin and the labels didn't show when printed.





RE: Coordinate System Symbol in Drafting
Tim Flater
NX Designer
NX 9.0.3.4 Win7 Pro x64 SP1
Intel Xeon 2.53 GHz 6GB RAM
NVIDIA Quadro 4000 2GB
RE: Coordinate System Symbol in Drafting
Format -> WCS -> Save
...now even if you toggle OFF the display of the WCS a CYS object will remain. Now since you're using the Master Model mode, while in the piece part, go into Reference Sets and add the CYS object to the Reference Set that you're using when you create your Drawing. You will now an X,Y,Z triad visible in your Drawing views.
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: Coordinate System Symbol in Drafting
Custom Symbol will give you more direct control of Text size and line weight if you desire it. You can make 1 symbol and have the axis labels as editable text so when you switch planes, you can change the text and size/scale of the symbol accordingly. You won't have to mess with Reference Sets or go over the the model and reposition or recreate the CSYS every time you have a new model or need to move the CSYS. You won't see the 3rd axis if you don't want to. Everything is done in Drafting and in 1 part file - moving the symbol is as easy as dragging it around and you can associate/disassociate the symbol to a view if you wish.
Either method will work, however.
Tim Flater
NX Designer
NX 9.0.3.4 Win7 Pro x64 SP1
Intel Xeon 2.53 GHz 6GB RAM
NVIDIA Quadro 4000 2GB
RE: Coordinate System Symbol in Drafting
With standard orthogonal views that only show two axis it should be fairly easy to make a custom symbol, although I'm not sure how you would rotate the symbol and maintain the correct text orientation.
What I'm mainly looking for is a good way to do this with non-standard "isometric" views. In some drawings I have to show many non-standard views and would like to be able to place a symbol in the drawing that I can move around to locations that make sense in the drawing view. I would like it to be able to inherit the correct coordinate directions and labels from the view I'm placing it in.
I'm currently doing this manually with arrow symbols and text then approximately lining up the orientations. This method works, I was just wondering if there was an easier way to do it that I wasn't aware of.
RE: Coordinate System Symbol in Drafting
RE: Coordinate System Symbol in Drafting
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: Coordinate System Symbol in Drafting
Now that all that has been taken care of, John's suggestion is more than likely the best for what you're wanting to do....optionally, you could put the CSYS in the dwg file rather than the component to avoid switching between parts and dealing with Reference Sets.
To take care of the CSYS being visible in all views, put the CSYS on a specific layer and utilize Layer Visisble in View to control in which drawing views the CSYS is visible. I don't believe View Dependent Edit will allow you to erase the CSYS (why, I have no clue).
Tim Flater
NX Designer
NX 9.0.3.4 Win7 Pro x64 SP1
Intel Xeon 2.53 GHz 6GB RAM
NVIDIA Quadro 4000 2GB