×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

warning messages in implicit analysis

warning messages in implicit analysis

warning messages in implicit analysis

(OP)
hello everyone,

I am modeling the axisymmetric tube hydroforming of aluminium tube by implicit analysis, the pressure is varied upto 22 MPa
For higher pressure from 15 MPa onwards I get the warning messages
The strain increment has exceeded fifty times the strain to cause first yield at 1331 points
The plasticity/creep/connector friction algorithm did not converge at 877 points
Convergence judged unlikely. Increment will be attempted again with a time increment of 2.25508e-03
FORCE equilibrium accepted using the alternate tolerance.

I have tried using a fixed time increment of 0.0001 but job is aborted
Is there any problem in material properties or in the step?

Thank you in advance

RE: warning messages in implicit analysis

(OP)
I have double checked everything and I also read the previous posts regarding the same warning messages but it is not working,if I further decrease fixed time increment to 1e-5 it takes much time.

RE: warning messages in implicit analysis

Do you have a back-of-the-envelope or a hand calculation to use as a reference? Try stepping back (a few steps, if the need be) by making simplifications until the response makes perfect sense to you and then build layers of complexity on top of it, one at a time.

Are you new to this forum? If so, please read these FAQ:

http://www.eng-tips.com/faqs.cfm?fid=376
http://www.eng-tips.com/faqs.cfm?fid=1083

RE: warning messages in implicit analysis

(OP)
thank you for your reply
I'll try your suggestion

RE: warning messages in implicit analysis

It seems that the material behavior and the load don't fit together. The load is too high or the material too weak.

Make sure that the maximum stress of your plasticity data isn't reached in the analysis.

RE: warning messages in implicit analysis

(OP)
the peak stress is around 260 MPa but I am putting upto 280 MPa. I applied max load increment of 0.0005 and no warning occured(linear variation of load) but as I changed the amplitude curve warnings appear again. Do I need to adjust proper amplitude curve? everything seems fine otherwise

RE: warning messages in implicit analysis

What is the definition of your own amplitude? Maybe the load gets scaled up with that definition.

RE: warning messages in implicit analysis

(OP)
For a step time of 1
amplitude curve is tabular type
time amp
0 0
1 1
no warning appears here for max load increment of 0.0005
now i changed the amp curve
time amp
0 0
0.4 1
1 1
warning appears here for max load increment of 0.00025

RE: warning messages in implicit analysis

In the second case the load is applied in a shorter time period, so with a higher rate. Depending on the analysis and other settings, that might create a different behavior. 'hard to say without knowing the model.

RE: warning messages in implicit analysis

Are you running it as an implicit static analysis or a quasistatic analysis using implicit dynamic? If you are running it as a static analysis, then the time period won't have any effect unless you are using material properties with rate-dependent plasticity. For instance, if your run your analysis with a time period of 1 s and it takes 2000 increments to solve, then each increment will be 0.0005 s. If you shorten the same exact problem to a time period of 0.4 s, it will still take 2000 increments to solve, and each increment will be 0.0002 s. So in this case, decreasing the time period does not speed up the analysis.

RE: warning messages in implicit analysis

(OP)
Thank you for replies

I have resolved the warning problem by limiting the max time increment to 1e-4 but for peak pressure the mises stress is around 291.8 MPa and PEEQ = 0.2 whereas my input stress = 263 Mpa and strain = 0.25. I am not applying rate dependent plasticity, the material obeys hill's normal anisotropy so I have used potential for R11,R22,etc. how is this possible?

RE: warning messages in implicit analysis

Looking in the Abaqus Analysis User's Guide for 6.14 you can see in section 23.2.6 "Anisotropic yield/creep" an explanation of how hill's potential function is implemented. You will see that your input stress of 263 MPa is the user defined reference yield stress σ0. So depending on the values you've used for the yield stress ratios, R11, R22, etc., it will have the effect of either increasing or decreasing the computed von Mises stress versus the computed von Mises stress without using the yield stress ratios and only the reference yield stress. So if you reran the analysis without the yield stress ratio's, you would get results that line up with your input stress and strain values.

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources