×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Cylindrica Connector Elasticity Not Working

Cylindrica Connector Elasticity Not Working

Cylindrica Connector Elasticity Not Working

(OP)
Hello all,

(first post)!

I am trying to use a CONN3D2 cylindrical connector and adding a simple linear elasticity to DOF1, lengthening. Unfortunately I don't think that the elasticity is working how I expect & want it to. The connector is lengthening up to 12mm, when i just want it to be incredibly stiff so I know it's working. Despite changing the F/dx curve it doesn't affect it. Here's the spring file, I'm pulling the connector outputs.

Any help would be greatly appreciated.

**RESTRAINT SPRING FILE
*NODE
	5499,	0.00,	-430.00,	-60.00
	5498,	0.00,	-430.00,	0.00
**
**
*MPC
BEAM, 5498,	690000
**
*ELEMENT,TYPE=CONN3D2,ELSET=EXT_RESIST
	59999,	5499,	5498
*CONNECTOR BEHAVIOR, NAME=EXT_RESIST_behavior
*CONNECTOR ELASTICITY, COMPONENT=1, NONLINEAR
0.0 , 0.0
100000 , 0.01
*CONNECTOR DAMPING, COMPONENT=1
0.05
*CONNECTOR SECTION, ELSET=EXT_RESIST, BEHAVIOR=EXT_RESIST_behavior
CYLINDRICAL,
axis_ORI
*ORIENTATION, NAME=axis_ORI, DEFINITION=NODES
5499, 690000, 5498
*MASS, ELSET=ext_resist_mass
1E-6
*ROTARY INERTIA, ELSET=ext_resist_rot
0.001,0.001,0.001
*element, type=mass, elset=ext_resist_mass
59998, 5499
59997, 5498
*element, type=rotaryi, elset=ext_resist_rot
59996, 5499
59995, 5498
** 

RE: Cylindrica Connector Elasticity Not Working

Hi,

Perhaps your deformation is in compression not in tension.
What values you have for CU1 output? Are they negative?

Displacement output (CU1) used to calculate force in connector is measured in local coordinate system.
In some situation element in global coordinate system is under tension but the same deformation measured in local coordinate system is in compression.

You can get this behaviour in your model as well:
Fix node 5499 and apply positive z global displacement for node 5498.
Animation shows the connector is in tension but CU1 output is always negative (in compression).

Your definition of elasticity cover only positive displacement.
By default Abaqus use constant extrapolation and it means for all negative CU1 you have zero force.

You can extend your characteristic for compression domain:

CODE

**
*CONNECTOR ELASTICITY, COMPONENT=1, NONLINEAR
-100000 , -0.01
0.0 , 0.0
100000 , 0.01
** 

or use linear extrapolation:

CODE

**
*CONNECTOR ELASTICITY, COMPONENT=1, NONLINEAR, EXTRAPOLATION=LINEAR
0.0 , 0.0
100000 , 0.01
** 

Regards,
Bartosz

RE: Cylindrica Connector Elasticity Not Working

(OP)
Bartosz,

That was my issue. While the spring was in fact in tension the coordinate system dictated a negative displacement. Thank you for your help.

Don

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources