×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Flatness call out for partial surface

Flatness call out for partial surface

Flatness call out for partial surface

(OP)
Hello

I was wondering if anybody had some advice on the proper way to call out a flatness tolerance using GD&T but only for a partial surface. The application is a mechanical seal. I've attached a drawing for illustration. The surface in question is labeled datum A with the .001 flatness call out. The only section of the surface that requires this control is enclosed in the rectangle. I'm just not sure how to properly notate this call out on the drawing. Thanks in advance for any advice.

RE: Flatness call out for partial surface

I would call out two points, a start and end, defining the extent of the controlled area, and use a FCF with a "between" symbol. The 'between symbol' is described in 3.3.11 of ASME Y14.5-2009, for example.

_________________________________________
NX8.0, Solidworks 2014, AutoCAD, Enovia V5

RE: Flatness call out for partial surface

Do you want the datum to also be taken as the local area, or should datum feature A remain as the full surface? (The answer will impact the suggested answers.)

John-Paul Belanger
Certified Sr. GD&T Professional
Geometric Learning Systems

RE: Flatness call out for partial surface

(OP)
Thank you for your response. That is helpful. I appreciate it.

RE: Flatness call out for partial surface

I've done variations on what JNieman says.

If you're using the surface/portion of the surface as datum that does add another level of complexity as Belanger mentions.

I've also introduced functionally unnecessary steps on a surface to help clarify which area needs tighter control but that's a last resort to me - though in some cases may help with likely manufacturing methods.

Posting guidelines FAQ731-376: Eng-Tips.com Forum Policies http://eng-tips.com/market.cfm? (probably not aimed specifically at you)
What is Engineering anyway: FAQ1088-1484: In layman terms, what is "engineering"?

RE: Flatness call out for partial surface

(OP)
Thank you all again for chiming in. I've attached another image of the drawing with the changes based on the suggestions here.

Quote (Belanger (Automotive)15 Apr 15 16:36
Do you want the datum to also be taken as the local area, or should datum feature A remain as the full surface? (The answer will impact the suggested answers.))


I noticed your response after I updated the drawing. In what way will this impact the call out?

RE: Flatness call out for partial surface

Could this fall under the limited length callout? 1.7.3 ASME Y14.5 2009 standard?

RE: Flatness call out for partial surface

I asked about the datum because the datum feature symbol is attached to your flatness callout. So it could be interpreted that whatever "limited length" you want to impose on the flatness also gets imposed on the datum feature. Thus my question.

Given your latest picture, I would probably go with the chain line suggestion rather than the "between X & Y" arrow.
Also note that the flatness tolerance would still be seen as extending into the picture for the full surface depth, within that strip of .247. If you wanted a limitation in the depth direction also, then you'd have to do something else to indicate that.

John-Paul Belanger
Certified Sr. GD&T Professional
Geometric Learning Systems

RE: Flatness call out for partial surface

Quote (SDETERS)

Could this fall under the limited length callout? 1.7.3 ASME Y14.5 2009 standard?

Yes, indeed.

Also, the purists may note that use of reference letters was defined for Profile tolerance and they are expected to indicate "extremities" of the features, that is, places where the features end rather than arbitrary points in the middle of said features. smile

"For every expert there is an equal and opposite expert"
Arthur C. Clarke Profiles of the future

RE: Flatness call out for partial surface

While I think that is a valid flatness specification I think your manufacturing engineer will throw it back in your face. This is obviously a revolved part from the diameter dimensions and run out specifications. You are carrying the flatness all the way into the inside corner at point X. You need to either allow some corner radius or an undercut, there is not such thing as a perfectly sharp inside corner.

----------------------------------------

The Help for this program was created in Windows Help format, which depends on a feature that isn't included in this version of Windows.

RE: Flatness call out for partial surface

(OP)
I've made some adjustments. I used the chain line instead along with a reference diameter to indicate where the flatness spec is needed. I also included the radius dimension for the inner corner which I had previously forgotten (Thank you dgallup for the reminder).

Quote (Belanger)

I asked about the datum because the datum feature symbol is attached to your flatness call out. So it could be interpreted that whatever "limited length" you want to impose on the flatness also gets imposed on the datum feature. Thus my question.

Yes, the datum feature will only be the the area of the surface indicated by the flatness call out and chain line. I've attached another updated drawing.

RE: Flatness call out for partial surface

Regarding the flatness and datum thing for the local area, I think it's pretty much OK now. On an unrelated note, maybe add a "CF" (for continuous feature) or similar notation on the 3.352 diameter so that it's clear that the diameter and the total runout tolerance are for the entire feature on both sides of the cutout. Otherwise that cutout/slot makes the requirements stop as soon as you get to the cutout/slot.

John-Paul Belanger
Certified Sr. GD&T Professional
Geometric Learning Systems

RE: Flatness call out for partial surface

(OP)
Ah yes, I will add that too. Thanks for pointing that out. Thanks again for the advice. I very much appreciate it.

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources