drawing view update fail nx9
drawing view update fail nx9
(OP)
Hi Guys,
Lately in several models I have such an error while updating view in drafting... What I did I've replaced component which is similar under drafing cad file and then wanted to update the views as long I need the same views ... but for just some of them update fails.
Anyone knows how to fix that? I see what that errors says just it is impossible to change anything in the model, it looks it is fine.
View Update Report
------------------
View name: SX@28
View type: Section view
Error: Unable to subtract solids for sectioning.
A solid could not be sectioned.
Part "108T5522G0001.prt" may have some invalid
geometry along the cut plane that is causing
operation the sectioning to fail.
Lately in several models I have such an error while updating view in drafting... What I did I've replaced component which is similar under drafing cad file and then wanted to update the views as long I need the same views ... but for just some of them update fails.
Anyone knows how to fix that? I see what that errors says just it is impossible to change anything in the model, it looks it is fine.
View Update Report
------------------
View name: SX@28
View type: Section view
Error: Unable to subtract solids for sectioning.
A solid could not be sectioned.
Part "108T5522G0001.prt" may have some invalid
geometry along the cut plane that is causing
operation the sectioning to fail.





RE: drawing view update fail nx9
do you get a message ?
Jerry J.
Milwaukee Electric Tool
http://www.milwaukeetool.com/
RE: drawing view update fail nx9
Tim Flater
NX Designer
NX 9.0.2.5 Win7 Pro x64 SP1
Intel Xeon 2.53 GHz 6GB RAM
NVIDIA Quadro 4000 2GB
RE: drawing view update fail nx9
Other things to try:
www.nxjournaling.com
RE: drawing view update fail nx9
this is the message I receive.
RE: drawing view update fail nx9
I am not certain how to do it in NX9, but basically you need to re-pick the points in the drawing view that are linked to the part and section lines.
Jerry J.
Milwaukee Electric Tool
http://www.milwaukeetool.com/
RE: drawing view update fail nx9
Cowski in the past yes it worked on different model that I move section plane a little bit from center point.
RE: drawing view update fail nx9
Info Analysis - Examine Geometry
Tiny Objects - Tolerance = 0.00040
Tiny objects found = 8
Please determine if these objects are correct or should be deleted
------------------------------------------------------------
Misaligned Objects
Misaligned objects = 12
Please determine if objects are correct or edit them to be correctly aligned.
------------------------------------------------------------
Data Structures
Bodies passed Structure test
------------------------------------------------------------
Consistency
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
------------------------------------------------------------
Face Intersections
Bodies passed face-face check
------------------------------------------------------------
Sheet Boundaries
No boundaries found
------------------------------------------------------------
Face Smoothness
Faces passed smoothness check
------------------------------------------------------------
Face Self-intersection
Self-intersecting face detected
Please replace incorrect face
Self-intersecting face detected
Please replace incorrect face
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting face detected
Please replace incorrect face
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting face detected
Please replace incorrect face
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting face detected
Please replace incorrect face
Self-intersecting face detected
Please replace incorrect face
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting face detected
Please replace incorrect face
Self-intersecting face detected
Please replace incorrect face
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting face detected
Please replace incorrect face
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting face detected
Please replace incorrect face
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting face detected
Please replace incorrect face
Self-intersecting face detected
Please replace incorrect face
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting face detected
Please replace incorrect face
Self-intersecting face detected
Please replace incorrect face
Self-intersecting face detected
Please replace incorrect face
Self-intersecting face detected
Please replace incorrect face
Self-intersecting geometry detected
Please replace incorrect geometry
Self-intersecting geometry detected
Please replace incorrect geometry
------------------------------------------------------------
Spikes/Cuts
Faces passed spikes/cuts check
------------------------------------------------------------
Edge Smoothness - Angle tolerance = 0.50
Number of unsmooth edges found = 81880
------------------------------------------------------------
Edge Tolerances - Tolerance = 0.00040
Edges exceeding specified tolerance = 1265
Maximum edge tolerance found = 0.00665152882174
------------------------------------------------------------
RE: drawing view update fail nx9
It might take a revision, but any part can be modified. If it has been released recently and is not yet in production, the "approvers" may be able to roll it back for modification.
It is my opinion that an "examine geometry" check should be part of the release process.
www.nxjournaling.com
RE: drawing view update fail nx9
RE: drawing view update fail nx9
RE: drawing view update fail nx9
Consistency
Self-intersecting geometry detected
Please replace incorrect geometry
Face Self-intersection
Self-intersecting face detected
Please replace incorrect face
The other objects in that report should not affect the section view.
When you have executed the test, there are tickboxes you can toggle to highlight the erratic faces.
Correct these, and revise the parts.
Regards,
Tomas
RE: drawing view update fail nx9
Info Analysis - Examine Geometry
Tiny Objects - Tolerance = 0.00040
No tiny objects found
------------------------------------------------------------
Misaligned Objects
No misaligned objects found
------------------------------------------------------------
Data Structures
Bodies passed Structure test
------------------------------------------------------------
Consistency
Bodies passed Consistency check
------------------------------------------------------------
Face Intersections
Bodies passed face-face check
------------------------------------------------------------
Sheet Boundaries
No boundaries found
------------------------------------------------------------
Face Smoothness
Faces passed smoothness check
------------------------------------------------------------
Face Self-intersection
Faces passed self-intersection check
------------------------------------------------------------
Spikes/Cuts
Faces passed spikes/cuts check
------------------------------------------------------------
Edge Smoothness - Angle tolerance = 0.50
Number of unsmooth edges found = 22847
------------------------------------------------------------
Edge Tolerances - Tolerance = 0.00040
Edges exceeding specified tolerance = 54
Maximum edge tolerance found = 0.0020
------------------------------------------------------------
RE: drawing view update fail nx9
RE: drawing view update fail nx9
What if I want to show interference in the section view?
What to do if I have a bolt and threaded hole where interference is not possible to omitt because it is always showing engagement?
Is it really intereference issue?
RE: drawing view update fail nx9
I have suppressed some operations that were making consistency error and the view has updated :) ... I need to figure out how to model similar geometry just with no cosistensy issue :)
RE: drawing view update fail nx9
View style -> hidden line tab -> check yes, with interference curves
Jerry J.
Milwaukee Electric Tool
http://www.milwaukeetool.com/