×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Pre_stressed normal mode using sol 103

Pre_stressed normal mode using sol 103

Pre_stressed normal mode using sol 103

(OP)
thread561-337439: Modal analysis of pre-stressed beam structure (NX Nastran)

Hello,

I want to use your first method with SOL103 using statsub .... when you talk about gravity load what is it? I saw that you were able to do this using FEMAP. can you send me the FEMAP program from your example?

You can also read my .bdf and tell me if a do a mistake.

Best Regards

RE: Pre_stressed normal mode using sol 103

Dear Ikey,
In fact, pre-stiffened modal analysis is a great feature of NX NASTRAN modal (SOL103) solver, but I don't know if other "nastran flavour" solvers are allowed to do it.
Since modal analysis is essentially solving the differential equation of free-vibration, the load is not in the equation. So in SOL 103, the load is ignored. There are two method to take into account the gravity load effect, one is the use of STATSUB, the other is using nonlinear analysis (SOL106) with preload.

Here you are the procedure in the case of the gravity load: you need to specify the gravity load in a static subcase and including the STATSUB case control in the dynamic subcase will cause the differential stiffness to be computed and included in the normal mode solution (a similar procedure could be followed to include linear surface-to-surface contact in a modal analysis)
Here is an example with general load, inlcuding gravity load:

CODE -->

$
$ Preloaded Modal Analysis
$
SOL 103
TIME	  60
CEND
$*
TITLE	 = Axial Loading on a Rod - stress stiffening
ECHO	 = SORT 
$*
SUBCASE = 1 
$*
SPC = 1 
LOAD = 1
$*
SUBCASE = 2 
$*
SPC = 1 
$DISPLACEMENT(PRINT,PUNCH) = ALL 
METHOD = 1
$ take load 1 into account in modal analysis
STATSUB = 1 
$*
$*$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$
$*
BEGIN BULK
$*
$*  PARAM CARDS
$*
PARAM	AUTOSPC YES 
PARAM	COUPMASS      -1
PARAM	GRDPNT	      -1
PARAM	OUGCORD GLOBAL
PARAM	POST	      -2
PARAM	POSTEXT YES 
$*
EIGRL	       1		      10       0       7	MASS
$*
$*  GRID CARDS
$*
GRID	       1       0     0.0     0.0     0.0       0
GRID	       2       0 2.00000     0.0     0.0       0
GRID	       3       0 .200000     0.0     0.0       0
GRID	       4       0 .400000     0.0     0.0       0
GRID	       5       0 .600000     0.0     0.0       0
GRID	       6       0 .800000     0.0     0.0       0
GRID	       7       0 1.00000     0.0     0.0       0
GRID	       8       0 1.20000     0.0     0.0       0
GRID	       9       0 1.40000     0.0     0.0       0
GRID	      10       0 1.60000     0.0     0.0       0
GRID	      11       0 1.80000     0.0     0.0       0
$*
$*  ELEMENT CARDS
$*
CBAR	       1       1       1       3     0.01.000000     0.0
CBAR	       2       1       3       4     0.01.000000     0.0
CBAR	       3       1       4       5     0.01.000000     0.0
CBAR	       4       1       6       5     0.0-1.00000     0.0
CBAR	       5       1       7       6     0.0-1.00000     0.0
CBAR	       6       1       8       7     0.0-1.00000     0.0
CBAR	       7       1       9       8     0.0-1.00000     0.0
CBAR	       8       1      10       9     0.0-1.00000     0.0
CBAR	       9       1      11      10     0.0-1.00000     0.0
CBAR	      10       1      11       2     0.01.000000     0.0
$*
$*  MATERIAL CARDS
$*
$*
$*  I-DEAS Material: 7	name: MATERIAL7
MAT1	       7200.00+9	.29000007800.0001.1700-521.85000     0.0+ 
+	1.5000+91.5000+96.8000+7
$*
$*  PROPERTY CARDS
$*
$*
$*  I-DEAS property: 1	name: LINEAR BEAM1
$*  Fore Section   : 1	name: CARRE
PBAR	       1       72.5000-35.2083-75.2083-78.8020-7     0.0	+ 
+	.0250000.0250000.0250000-.025000-.025000-.025000-.025000.0250000+ 
+	.8333333.8333333
$*
$*  RESTRAINT CARDS
$*
SPC	       1       2    2345     0.0
SPC	       1       1   12345     0.0
$*
$*  LOAD CARDS
$*
FORCE	       1       2       01.000000-100000.     0.0     0.0
$*
ENDDATA 

Best regards,
Blas.

~~~~~~~~~~~~~~~~~~~~~~
Blas Molero Hidalgo
Ingeniero Industrial
Director

IBERISA
48004 BILBAO (SPAIN)
WEB: http://www.iberisa.com
Blog de FEMAP & NX Nastran: http://iberisa.wordpress.com/

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources