How to paste a symbol onto a surface?
How to paste a symbol onto a surface?
(OP)
Hi guys, I'm trying to paste a circular symbol onto an angled face/surface. The symbol came from a different part, so its position is way off. How would I move it directly onto the face I want?
Thanks for any help in advance!
Thanks for any help in advance!





RE: How to paste a symbol onto a surface?
I'm having difficulty keeping the text perfectly aligned with the surface.
RE: How to paste a symbol onto a surface?
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: How to paste a symbol onto a surface?
I used Menu > Edit > Align > Best Fit or Point Set to Point Set to align the text and symbols with the part. And then I used Project Curve to project them onto the surface of said part.
Anyways, I ran into another problem. I'm trying to use the Extrude tool to subtract the shape of the symbol into the surface of my part.
It's a pre-made symbol, composed of 61 splines/curves. But whenever I try it, I get the error in the image below:
"Alerts: Unable to create body - change the section."
What am I doing wrong?
RE: How to paste a symbol onto a surface?
www.nxjournaling.com
RE: How to paste a symbol onto a surface?
BTW, just as a heads-up, starting with NX 10.0, the default, out-of-the-box, modeling 'Distance' tolerance has been changed to 0.0100 mm and 0.0004 inches (the default 'Angle' tolerance has not changed).
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: How to paste a symbol onto a surface?
John, changing the tolerance and end distance fixed the problem, thank you!
Also, one more question: is it ideal to simply change the tolerance for a problem such as this? I feel like its a simple shortcut around the problem.
Nonetheless, thanks guys!
RE: How to paste a symbol onto a surface?
BTW, the reason for our recent change in the default modeling Distance tolerance is because over the years, the size of tha typical piece part modeled by our customers using NX has become smaller. When Unigraphics was first developed back in the mid- to late-70's, many of our customers were in the aerospace sector (after all, for years Unigraphics was developed and sold by McDonnell Douglas). However, over the last 20 years or so, our 'sweet spot' in the industry has moved toward automotive, where the typical piece part size is much smaller. Therefore, starting with NX 10.0 we've switched our default Distance tolerance to the standard that was adopted by the majority of the automotive OEM's and their suppliers, that is 0.0100 mm (0.0004 inches). But as always, these default tolerances can be changed and they should be reviewed when purchasing CAD and selecting something appropriate for your particular product line.
As for your question about is it OK to set the tolerance for a single operation, the answer is YES. After all, why do you think we include an option to set the tolerance inside of specific modeling functions. But note that changing the tolerance values while in a feature dialog will ONLY effect the tolerance used for that particular operation and will have no impact on the default (AKA pre-set) modeling tolerance that was saved with the part file. However, changing the tolerance in Preferences -> Modeling and saving the part will change it for any subsequent modeling operations but it will have no impact on features already created. Also note that not all modeling operations are affected by the tolerance settings. Generally speaking, those features or operations where tolerance is a factor, those are the ones where you'll find a tolerance option in the settings section of the dialog. Also note that for most of these features, the tolerance itself will be become part of the parametric values of that particular feature, often even showing-up as its own expression. And before you ask, there is no way, at least not as part of an interactive operation, to change the tolerance of all of the features of a model. Please note that while there are some CAD systems which does allow you to do that, Pro-E comes to mind, it is generally NOT something that you should be doing as it can be problematic and so we decided years ago to not provide a way to do that. If you feel that you need to tighten or loosen the tolerance on your models, for whatever reason, it should be done on a feature by feature basis so as to know exactly how this will impact the results and the reliability of updating.
Anyway, I thought that you should know how all this works and why.
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: How to paste a symbol onto a surface?
Just wondering why when I change Tolerance for modeling (general- distance) in customer default from .0004" to .001" (NX10) in default level (user)
after restarting NX , still G0 position in modeling (surface creation i.e. sweep , mesh,... ) remain unchanged to default .0004
RE: How to paste a symbol onto a surface?
www.nxjournaling.com
RE: How to paste a symbol onto a surface?
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: How to paste a symbol onto a surface?
Despite the NURBS standard, there are a couple of things that can be done to splines within the Nurbs standard which NX doesn't like that much. Have a look at these curves and see if you can re-create or clean them in NX in a simple way.
having clean curves will produce clean faces which updates quickly and produce small files which opens quickly...
Regards,
Tomas
RE: How to paste a symbol onto a surface?
I knew about opening new model to take in effect but,
Actually I tested it does not change even with new model creation?! in my case
when I check in customer default tolerance is correct as I defined .001" but
in functions still it shows .0004"
attached shows after changing tol. to .001"
thanks
RE: How to paste a symbol onto a surface?
www.nxjournaling.com
RE: How to paste a symbol onto a surface?
Thank you that is the point creating in blank template update whatever Tol. defined
Problem Solved
Thanks again
RE: How to paste a symbol onto a surface?
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.