×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

NX Advanced Simulation 3D 1D connection

NX Advanced Simulation 3D 1D connection

NX Advanced Simulation 3D 1D connection

(OP)
Hello,

For students I am preparing an exercise for working with different types of elements tetra10, cquad8 and a 1D element.

The exercise is to calculate the results from a solid eg. 200 6 12 (l w h) calculate the displacement with FEM and manually.

2nd is two separate solids each 100m long connected to each other eg. meshmating or glueing calculate results

3rd exercise is create a mid surface plane of the "right" solid. and connect this to the solid with appropriate method eg. meshmating /glue/spider and verify.

I have trouble to connect a bar or a beam element to the 3D element. the element connects but gives a displacement in the order 1E14 when the solid bends.
See attachment.

With an axial load I get a normal result.

Can anyone direct me in the correct way?

Regards,

Olaf

RE: NX Advanced Simulation 3D 1D connection

Hello Olaf,

This is about Degree of Freedom (DOF).

This is because 1D element beam or bar elements has 6 DOFs, except of 1D rod element has 3 DOFs.

3D elements have 3 DOFs only.

When you connect the node of 1D beam element to the node of 3D element, the connection is representing a pin joint, because the rotational DOFs from the 1D element could not be transfer to the 3D elements. Thus information loss.

If you are applying axial load at one end (the other end fixed), the displacement is still normal, because the pin joint is there to secure the position to achieve equilibrium. However, not for bending load (if you are using linear static solution).

A quick fix to this problem, is to apply a spider connection (in NX called 1D-connection), using RBE2 element, node to node type, that linked the 1D node (independent node) to the adjacent surface's nodes of the 3D elements (dependent nodes). This would ensure the moment be transferred/converted into force load at the connected nodes of the 3D elements.

Hope this helps.

Tuw

RE: NX Advanced Simulation 3D 1D connection

(OP)
Hello Tuw,

I thought it had something to do with DOF's
I tried it with point 2 point, no good results.
I have in NX7.5 only source and target, maybe I mixed it up.
After that I tried it with point 2 face
and I got the expected results :)

See attachment

Regards,

Olaf

RE: NX Advanced Simulation 3D 1D connection

I am more like a manual guy, that's why I choose node-to-node most of the time. Anyway, glad you make it. :)

Tuw

RE: NX Advanced Simulation 3D 1D connection

(OP)
Hello Tuw,

I tried it with node to node but i got not the expected results.
I will try again next week.

Regards,

Olaf

RE: NX Advanced Simulation 3D 1D connection

Hello Olaf,

The difference between point-to-face and node-to-node, is the former is geometrical associated, while the latter is non-geometrical associated. Both methods are capable of doing the job, because in the end, it all boils down to an exact/similar input keywords in the input file (.dat).

For the source node, it is usually the 1D element's node, while for the target nodes, it is usually at the 3D elements' nodes. Perhaps while selecting the target, you could set the selection method as "Feature Angle Nodes", which would help to select all the nodes (within the angle tolerance) at that particular element face you click. Please note that if you only selected 1 node as the target, most likely it would not work.

If it still wont work, you can attach your input file (.dat file) here for diagnosis.

Regards,
Tuw

RE: NX Advanced Simulation 3D 1D connection

(OP)
Hello Tuw,

Thanks for your time and expertise.
I did indeed select only one node instead of many nodes on the 3D part.
I was misled by node to node name of the item should be node(s) to node(s) smile
Results are as expected.

Regards,

Olaf

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources