×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Elastoplastic Analysis of an Offshore Component

Elastoplastic Analysis of an Offshore Component

Elastoplastic Analysis of an Offshore Component

(OP)
Hi everyone!

I was running an elastoplastic analysis of an offshore component with three different mesh refinements in Abaqus. The attached figure illustrates the meshes and the distribution of the equivalent plastic strain (PEEQ) for each mesh. A steel cable will tied in the hole and a force of 105 kN will be applied in the downward direction. The left side is fully constrained (encastred).

As you can see, the PEEQ jumped from a low value of 2.456% (coarser mesh) to 188.33% (finer mesh). In this case, the element size of the finer mesh is about 1/3 of the coarser mesh. Have you guys been through such similar situation, where the stress or plastic strains increased as the mesh was refined? One more thing: the force was applied by means of rigid elements (Kincoup).

Thank you in advance.






RE: Elastoplastic Analysis of an Offshore Component

finer mesh is more sensitive to load spikes ... how distributed is the applied load ?

can you extract nodal results from the coarse model ? compare to a fine mesh element ?

another day in paradise, or is paradise one day closer ?

RE: Elastoplastic Analysis of an Offshore Component

(OP)
rb1957, thank you for your prompt reply.

The way I distributed the load can be seen in the attached figure. The red lines are the rigid elements (Kincoup). And they were distributed on the area of contact with the steel cable pin. Then, the load was applied on the central node. I tried to represent the steel cable pin by a cylindrical rigid surface and apply the contact condition, but I got overclosure problem. Even when I moved the cylindrical surface away from the contact surface in the hole, the overclosure problem remained. Thus, the utilization of Kincoup elements was my only alternative.

I took a look at the node values from both meshes and the difference between them is also huge. The maximum values are: coarser mesh (PEEQ) = 1.7% and finer mesh (PEEQ) = 216.7%.

I´m sorry, but what do you mean by "load spikes"? I don't get it.

Thank you in advance.

RE: Elastoplastic Analysis of an Offshore Component

If you can't model it with contact (and you should be able to), you might apply the load as a cosine distribution to the hole. The way you are applying the load appears to be creating very localized peak stresses that are not real. If you run an elastic-plastic analysis this should "go away" though and give you a more realistic result. If you are trying to find the ultimate capability, these localized peaks won't matter too much. I am not sure what your goal is though.

As you increase the mesh density, you are better able to capture the stress concentration. At some point, you will reach an asymptotic value, but only if the load is applied in a reasonable manner. You may want to try a simple model and compare your answer to Peterson's stress concentration. I have found that the stress concentration for pin loaded parts can vary a decent amount based on whether you use contact (and the amount of clearance) or if you use simulated cosine load. But you should still be able to get a reasonable comparison to Peterson's. I am not sure that is the case with your current model.

Brian
www.espcomposites.com

RE: Elastoplastic Analysis of an Offshore Component

(OP)
Thank you guys for your help.
I could model the contact and it worked. The plastic strains are now in an acceptable level.

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources