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Split Body using Non-planar surface?

Split Body using Non-planar surface?

Split Body using Non-planar surface?

(OP)
How to split a body using a non-planar surface as tool?

RE: Split Body using Non-planar surface?

you can either subtract the non-planar surface from the solid body
or you can trim to it

RE: Split Body using Non-planar surface?

Set the split body tool option to "face or plane", adjust your selection intent rule if necessary, and select the faces to use as the split tool.

www.nxjournaling.com

RE: Split Body using Non-planar surface?

(OP)
@jerry1423
thanks for your reply.
I don't want to subtract or trim the body. I just want to split the single body into two bodies using its non-planar surface. Is it possible?

RE: Split Body using Non-planar surface?

From what I understand the split body command keeps both bodies. no exceptions.

The trim body command is the one where a body is subtracted on a specified side of a surface or plane.

RE: Split Body using Non-planar surface?

(OP)
@cowski
Not able to set a non-planar face as tool to split.
I am using NX8

Thanks

RE: Split Body using Non-planar surface?

You are able to use subtract and get the same result as if it was a split of a planar surface, just give it a try (you can always undo it)
and make sure the menu is fully expanded with the toggles set the way you want them

RE: Split Body using Non-planar surface?

Split body works fine for me with a non-planar surface?

The subtract is nice as well though didn't know you could do that!

www.jcb.com
NX 8.5 with TC 8.3

RE: Split Body using Non-planar surface?

(OP)
@jerry1423
in 'subtract' option, I am not able to select the 'face' as tool. It asks for 'body'.

RE: Split Body using Non-planar surface?

Quote (sluzzer)

Not able to set a non-planar face as tool to split.

The option exists and it works. Does the face you are attempting to use completely divide the body?
Perhaps a pic of what you are attempting to do would help.

www.nxjournaling.com

RE: Split Body using Non-planar surface?

you should be able to select the face, check what your selction filter is set to

RE: Split Body using Non-planar surface?

(OP)
Thanks everyone for the reply..
Yes it works :)
But in some model it not works for me. I think I have not understood something properly. I am trying to use the face of the body itself to use as tool. please see the attached model. I want to split the model into 2 bodies & I want to use the spherical face as the tool. How to do it?

From the question by cowski "Does the face you are attempting to use completely divide the body?", I understands that the face which we are going to use as a tool should completely divide the face. In the attached model, the spherical face does not pass through the intersection. So in this case, how to split it?

Thanks

RE: Split Body using Non-planar surface?

You can't use a face of the body to split the body, it needs to be a separate feature.

So you could extract a copy of the spherical face to use as your "splitting object", but you are left with a hole in the top of the extracted face.

So your best bet actually would be to create a new "splitting object" as a sketched and revolved surface.

www.jcb.com
NX 8.5 with TC 8.3

RE: Split Body using Non-planar surface?

you can extract a face and toggle "delete holes" and then you can do what needs to be done here

RE: Split Body using Non-planar surface?

(OP)
@ jerry1423 & cowski.. Thank you very much :)

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