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Bring Back the REAL Transform
11

Bring Back the REAL Transform

Bring Back the REAL Transform

(OP)


look, it was funny when you tried to hide all of the transform functions in 7.5 so that we all had to use the move upgrade....but then we found that all you had to do is hit the transform button, click what you wanted to move then hit your center mouse button 3 times and it all came back....GREAT TRICK!

but taking it completely out in 8.5? are you trying to stop proficiency and make all of us dislike your system?

transform is very useful for those of us who need to manipulate solid model

RE: Bring Back the REAL Transform

I agree.
The Move command is very awkward to use sometimes.

RE: Bring Back the REAL Transform

Transform is still there isn't it? I can't remember what the command is, but to move a solid body I always hit Ctrl-T.

RE: Bring Back the REAL Transform

oh yea, it is in NX7.5
go to your command finder and enter "transform"

Help -> Command Finder

RE: Bring Back the REAL Transform

Well, there's obviously still a "hole" in NX9 functionality as this variable is still available ...

UGII_ENABLE_TRANSFORM_LEGACY_OPTIONS=1

NX 9.0.2.5 (Desperate for 9.0.3)
NX 10 (Testing)
Windows 7 64 (Windows 8.1 Tablet)

RE: Bring Back the REAL Transform

(OP)
someone tell if this works in nx 9.0. (IT DOES WORK IN 7.5 BUT NOT IN 8.5)

1. click the TRANSFORM command.
2. pick SOLID BODY
3. select OK
3. click down on your center mouse button 3 times (just like in the wizard of oz with the ruby shoes)
4. on the line where it says TRANFORMATION TYPE - SCALE
4. you should get your old transform commands back up.

they hid that one good.

RE: Bring Back the REAL Transform

jstong ... Create the environment variable I refer to and the "full" legacy transform dialog will be made available.

NX 9.0.2.5 (Desperate for 9.0.3)
NX 10 (Testing)
Windows 7 64 (Windows 8.1 Tablet)

RE: Bring Back the REAL Transform

(OP)
phillpd......how do you create the environment variable. I don't know that terminology.

RE: Bring Back the REAL Transform

Windows-start ( bottom left on the screen)
In the white field "Search programs and files" Type "sys", the dialog should then display the option "edit the system environment variables"
In this dialog, middle tab "Advanced" - Environment Variables...
go bottom left "New..."
Variable name: UGII_ENABLE_TRANSFORM_LEGACY_OPTIONS
Veriable value: 1

OK out of dialog
The variable will be in action in your next NX session.


Regards,
Tomas

RE: Bring Back the REAL Transform

Have you tried Insert-> Associative Copy -> Instance Geometry In NX 8 and 8.5?

RE: Bring Back the REAL Transform

Why are you asking? But since you have this might be relevant; starting with NX 9.0, 'Instance Geometry' has been replaced with 'Pattern Geometry' using the same basic 'Patterning' service first introduced with NX 7.5 Sketcher 'Pattern Curve' and NX 8.0 'Pattern Feature'.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

RE: Bring Back the REAL Transform

You cannot mirror geometry in move also which is a pain.

RE: Bring Back the REAL Transform

Of COURSE you CANNOT mirror geometry using the 'Move Object' function since Mirroring is NOT a 'move operation'. That's what the 'Mirror Geometry' function is for. After all, we've had a 'Move Component' function for years when working with Assemblies and I can't ever recall a single complaint that the list of 'Move' options didn't include the ability to 'Mirror' a Component. Perhaps it was because we've also supported, for almost as long, a separate 'Mirror Assembly' function.

The changes that were made to the old Transform function and how the various options were migrated out to other places in the UI was done to make the software more logical and easier to learn and use. After all, if you were a new user of NX, what would possess you to go to a 'Move' function to perform a 'Mirror' operation? There is no logical relationship between 'moving' something and creating the mirror-image of something. The only relationship that exists in YOUR mind is what was put there by your years of using UG/NX. Unfortunately, new users looking at NX for the first time has no hint that you should expect to find a 'Mirror' operation under a button labeled 'Move'.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

RE: Bring Back the REAL Transform

I thought the button was originally called TRANSFORM not MOVE which could imply either move or mirror or scale.

Win7 64 bit w/NX7.5 and NX9.0.2.5
Vericut 7.3

RE: Bring Back the REAL Transform

Yes, when it was only 'Transform' then that term was inclusive enough to cover a myriad of types of operations, but once we decided to create more explicitly named sets of functions, such as 'Move', then we also had to create separate 'Scale' and 'Mirror' functions as well, but in the long run this will help people find the appropriate command easier since they will be more discoverable and since they are now more 'single-minded', the dialog workflows can be optimized for the specific TYPE of operation being performed. People complain about too many keystrokes yet did anyone notice that by moving items off the 'Transform' main dialog that we saved you an extra layer of dialogs to navigate thru?

And please note that 'Transform' has not actually gone away but instead has simply been 'pruned down' to only those few functions which have not yet been 100% replaced by something more modern.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

RE: Bring Back the REAL Transform

4 point fit still available, or was that "pruned" too?

Proud Member of the Reality-Based Community..

To the Toolmaker, your nice little cartoon drawing of your glass looks cool, but your solid model sucks. Do you want me to fix it, or are you going to take all week to get it back to me so I can get some work done?

RE: Bring Back the REAL Transform

Yes you are right John a mirror function probably doesn't belong under "move" but mirror component Or mirror assembly does not work for mirroring a single or group of individual surfaces when building sheet body's. That transform/mirror command has been a useful tool for me for the past 20+ years working on UG/NX. Guess I'm just "old school" and didn't mean to upset you. :)

RE: Bring Back the REAL Transform

I never used the transform command as I started out using the move command system in NX 5 - honestly say that the move command has to be one of the simplest in the software so can't really comprehend what the issue is. You do right click move and then click on the arrow in the direction you want to go and either key in a distance or drag on the arrowhead or the round blob thing in the middle of the part and you're done. I must be missing the holy grail of the old Transform command...

Scaling a part is possible as well but in the 3D world not usually practical or desirable really as rarely would you have a component that scales in all three directions equally in a product range...

Solid Edge; I-Deas 7 to 12; NX4, NX5 NX6 & currently NX7.5 / TeamCenter 9.1 & Ansys 14.5 on 6GB Windows 7.

RE: Bring Back the REAL Transform

I have no problem with the move command as it exists, but have to disagree with scaling not being practical or desirable... use it often when modeling composite related molds to great effect.
I have also not had a problem mirroring individual or group of surfaces. The commands are still there, just have migrated around a bit.
As long as such commands are still available (and can be easily located), I'm a happy camper.

“Know the rules well, so you can break them effectively.”
-Dalai Lama XIV

RE: Bring Back the REAL Transform

Scaling is still useful for pattern making or vac-form tooling. In most cases we do it in the cutterpath but we do have some customers that require an "expanded" model file.

RE: Bring Back the REAL Transform

Scaling is quite useful on a temporary basis for castings that are not modeled with shrink factor built in - take the finished casting, scale it, export it and now the mold maker has a scaled casting from which he can cut the molds. I used to use the command all the time.

Tim Flater
NX Designer
NX 8.0.3.4
Win7 Pro x64 SP1
Intel Xeon 2.53 GHz 6GB RAM
NVIDIA Quadro 4000 2GB

RE: Bring Back the REAL Transform

Yes, like it or not, CTE (thus scale) is an intregral part of many engineering processes.

“Know the rules well, so you can break them effectively.”
-Dalai Lama XIV

RE: Bring Back the REAL Transform

Based on the last several posts, I hope that it's becoming apparent that despite the fact that this issue has generated a lot of comments and responses, that in the end NO functionality has actually been lost. The changes that were made was simply part of the evolution of NX as many of these 'operators' were upgraded first to be Parametric, in that they created editable features (optional in many cases) as well as to adhere to the new block-style dialog design, introduced in NX 5.0.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

RE: Bring Back the REAL Transform

It was nice to have it under one dialog that us long time users were used to, but thats what customization is for.

RE: Bring Back the REAL Transform

Well now you can created a custom Ribbon tab and collect all of your favorite, and now independent/explicit, functions where they all can be quickly found.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

RE: Bring Back the REAL Transform



Like so... It's very easy to do. Customizing the toolbars or I guess I should be referring them as Ribbon bars has never been easier in the 15 years or so I've been using the software

RE: Bring Back the REAL Transform

To add to the discussion.

In some instances we have not lost functionality, but we have lost performance.
We regularly use the scale function when creating windtunnel models that are scaled down versions of full size geometry.
We do not want/need a parmetric link between these parts due to the speed of changes and the overhead of trying to manage the parametricity (long story and off topic)
The old transform function allows us to create scale functions that are non parametric in 1 step.
The scale function however has no non-parametric option and therefore takes a long time to create parametric scales (our parts are sheet based and have 100's of sheets)which we then have to remove prameters.

The other issue I have with the parametric 'transform' functions is that as far as I'm aware curves can't be paramterically 'transformed' so we have to use workarounds (like extruding the curve to allow us to move it).

The scale function has no option to scale curves at all so once again we have to use a workaround.

Mark Benson
Aerodynamic Model Designer

To a Designer, the glass was right on CAD.

RE: Bring Back the REAL Transform

Scaling curves is the one reason I keep the "legacy" Transform icon on my toolbar.

“Know the rules well, so you can break them effectively.”
-Dalai Lama XIV

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