Invisible Object in Entire Part reference set
Invisible Object in Entire Part reference set
(OP)
I have an assembly which I am editing, which was originally created by someone else. It is exhibiting some very bizarre behaviour, as follows:-
I have ensured all layers are visible, and "visible in view" also has all layers on. I even ran this journal which was suggested on a previous posting, however it didn't manage to reveal the solid geometry I'm expecting to see.
Can anyone offer any suggestions?
Cheers,
TechieGeek
- If I view the child part from within the parent assembly with the Model reference-set I can see the solid-body of interest.
- If I view the Entire-part reference-set, the solid-body is no longer visible.
- If I make the child the displayed part, I still cannot view the solid body.
I have ensured all layers are visible, and "visible in view" also has all layers on. I even ran this journal which was suggested on a previous posting, however it didn't manage to reveal the solid geometry I'm expecting to see.
Can anyone offer any suggestions?
Cheers,
TechieGeek





RE: Invisible Object in Entire Part reference set
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: Invisible Object in Entire Part reference set
Cheers,
TechieGeek
RE: Invisible Object in Entire Part reference set
Can you upload that specific component ? ( Or Confidential.)
Regards,
Tomas
RE: Invisible Object in Entire Part reference set
Cheers,
TechieGeek
RE: Invisible Object in Entire Part reference set
Cheers,
TechieGeek
RE: Invisible Object in Entire Part reference set
I'm not that familiar with this website... how do I upload a file?
Cheers,
TechieGeek
RE: Invisible Object in Entire Part reference set
www.nxjournaling.com
RE: Invisible Object in Entire Part reference set
I have stripped out all of the other geometry, and uploaded the file here for you all to interrogate.
Thanks for all your help so far... but still looking for a fix, as there's a lot of history within my original file which I can't afford to recreate.
Cheers,
TechieGeek
RE: Invisible Object in Entire Part reference set
I've no idea which version of NX was used to create the original part from which I've inherited this problem.
Cheers,
TechieGeek
RE: Invisible Object in Entire Part reference set
I have found the solid. It' view dependent on the drawing.
I have not found a way to get is model dependent..
Regards,
Tomas
RE: Invisible Object in Entire Part reference set
Bottom line, There is nothing wrong with your Part file! The only problem is that in the case of a Drawing with only View Dependent objects, Reference Sets are all but meaningless. After all, what was it that you thought you were going to benefit from whether the Drawing was or was not included in any of the Reference Sets? I hope you weren't thinking of creating an Assembly where one of the the Components would be a Drawing. If so, what were you going to do with it? What benefit were you going to gain? How was this going to be used in your product design and manufacturing workflow?
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: Invisible Object in Entire Part reference set
Why is the offending wave-linked solid view-dependant, and how can I make it model-dependant?
Cheers,
TechieGeek
RE: Invisible Object in Entire Part reference set
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: Invisible Object in Entire Part reference set
- I doubt that they can explain why it got this way but i think that they can help you repair the original part.
Regards,
Tomas
RE: Invisible Object in Entire Part reference set
I ATTACHED THE PPT FILE
RE: Invisible Object in Entire Part reference set
1. Open a new, blank part file.
2. Use File -> Export -> Part and export ONLY the solid to the new part file, do not choose any dwgs, however make sure to retain internal parameters.
3. Go over to the new part file and enter Drafting and Open the drawing named SHT001.
4. Edit -> View -> View Dependent Edit and pick the dwg sheet.
5. From the View Dependent Edit dialog, pick View to Model. Select the solid.
6. Your solid should now be visible in Modeling.
I tested the visibility of the solid body by adding it as a component to a new part file and it behaved normally. Hopefully everything you require will somehow export over to the new part. If not, try copy/paste. With the mess you have, you may have to recreate some things. Be mindful to NEVER import solid geometry or entire parts into Drafting into the future. IMO, if importing a part into Drafting behaves this way, then this is a bug in the Drafting application, as solids should NEVER be allowed to appear on a sheet.
Tim Flater
NX Designer
NX 8.0.3.4
Win7 Pro x64 SP1
Intel Xeon 2.53 GHz 6GB RAM
NVIDIA Quadro 4000 2GB
RE: Invisible Object in Entire Part reference set
Perform a View Update (Edit -> View -> Update and allow all views to update. You will get a message that the update fails. Click Suppress after each update, then begin the steps above.
Tried to include a movie, but the file is too large I guess - won't upload.
Tim Flater
NX Designer
NX 8.0.3.4
Win7 Pro x64 SP1
Intel Xeon 2.53 GHz 6GB RAM
NVIDIA Quadro 4000 2GB