Different views with different reference set
Different views with different reference set
(OP)
Hi,
I've a part that has two body inside, one is the screw and the other is the clip.
I've three reference set, one 'model' with two body, one reference set with the clip body and one with the screw body.
This part is bought with these two parts.
I need to make a drawing that explain the dimension of the forniture.
How can I make two different view that are linked to two different reference set ?
See attached image.
I've a part that has two body inside, one is the screw and the other is the clip.
I've three reference set, one 'model' with two body, one reference set with the clip body and one with the screw body.
This part is bought with these two parts.
I need to make a drawing that explain the dimension of the forniture.
How can I make two different view that are linked to two different reference set ?
See attached image.
Thank you...
Using NX 8 and TC9.1





RE: Different views with different reference set
“Know the rules well, so you can break them effectively.”
-Dalai Lama XIV
RE: Different views with different reference set
You don't. Reference sets are not intended to control drawing views.
I'm not sure that arrangements will work if both bodies are contained in the same file. Arrangements work best with components. You could make a proper assembly out of the two bodies, then use arrangements. Alternatively, you could also use "layer visible in view" or a view dependent edit
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RE: Different views with different reference set
We attend Jhon or I open an IR.
Thank you...
Using NX 8 and TC9.1
RE: Different views with different reference set
A/
At the drafting level, put each body an different layer.
And then, make them visible or not in your views using the "layer visible in view" (Ctrl+shift+v)
A bit tricky as nothing indicate it. Would be a kind of mistery if someone else is working on your file.
B/
Use the "Hide Component in view" tool. (Drafting edit toolbar)
In your case, as you have few objects, i'll go with B.
Stéphane
"My english is bad ? That's why i'am french."
RE: Different views with different reference set
www.nxjournaling.com
RE: Different views with different reference set
Thank you...
Using NX 8 and TC9.1
RE: Different views with different reference set
"Hide component in view" won't work as your 2 bodies are inside the same file (not assembly components).
"My english is bad ? That's why i'am french."
RE: Different views with different reference set
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: Different views with different reference set
“Know the rules well, so you can break them effectively.”
-Dalai Lama XIV
RE: Different views with different reference set
www.nxjournaling.com
RE: Different views with different reference set
In sheet metal there is the flat solid (which will get added to its own reference set) and the flat pattern (curves that will be added to a custom view). If/when you create a drawing file and add your sheet metal part as a component, you can change between the flat solid and model reference sets to see your part in different states. But you cannot use both reference sets simultaneously to get two different views of your part on the drawing. If you are using the model ref set and create a drawing view, the drawing view will show the model ref set. When you change to the flat solid ref set, upon updating, the view will show the flat solid. You can add the custom flat pattern view from the sheet metal part to view that on the drawing, but that is not using reference sets to control a drawing view.
www.nxjournaling.com
RE: Different views with different reference set
what NX does for sheet metal parts can be replicated on normal parts, I've to use the John solution.
Thank you...
Using NX 8 and TC9.1
RE: Different views with different reference set
This is true, but this discussion about sheet metal is a red herring. There is nothing sheet metal does that will solve the problem you originally posted.
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