NX 6.0 to 8.5
NX 6.0 to 8.5
(OP)
I am moving my current company from NX 6.0 a la carte licensing to 8.5 full mach bundles. We do full machine builds so alot of sheet metal, flat patterns, machining.
Beside the huge UI shock to some of my older user are there any other pitfalls or hurdles any of you have ran across making the jump to current from way behind and out dated
Beside the huge UI shock to some of my older user are there any other pitfalls or hurdles any of you have ran across making the jump to current from way behind and out dated
Ryan Lee
Design Engineer
If you can think it it can be modeled





RE: NX 6.0 to 8.5
Another big 'sticker shock' is that skipping this many versions will mean that at larger number of older commands have been either obsoleted and/or completely replaced with new functions. Also some functions, while they've not gotten a big redesign, did have their names changed such as 'Hollow' became 'Shell' and 'Taper' became 'Draft'. To help you with this, there's a new function called the 'Command Finder'. This will become a 'good friend' for you users as they look for the new and/or renamed functions (for example, entering 'hollow' will return 'shell' and will show you were you can find it).
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: NX 6.0 to 8.5
Just curious because the company I am at is currently on NX8.0 and planning to roll out 8.5 later this year. They refuse, however, to do a refile, so there are many older released parts still in 6.0 and 7.5. I've long suspected that assemblies load slowly due to the fact that many parts are in 6.0 and 7.5, but haven't been able to convince the "higher-ups" that the refile is necessary. They don't want to spend the time or money to do that. I'd like some good concrete data to give them on why it is important to do a refile, so any info you have is helpful!
NX 8.0/TC8
RE: NX 6.0 to 8.5
In short, with refile, you will do drawings faster.
RE: NX 6.0 to 8.5
"Wildfires are dangerous, hard to control, and economically catastrophic."
Ben Loosli
RE: NX 6.0 to 8.5
Now if you don't run 'refile' and you later wish to take advantage of the lightweight views in Drafting, while the new parts (created in NX 7.5 thru NX 8.5) will work fine since the new lightweight data is automatically being created on-the-fly as you create and edit your models, if any older pre-NX 7.5 parts which have NOT been 'refiled' are included in an Assembly, when you attempt to add your Drawing views the Hidden Line results will not be correct. What will happen is that only the new parts will be properly rendered while the legacy, non-refiled parts, will be ignored.
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: NX 6.0 to 8.5
Will it hurts us to run 8.5 for 6 months before the refile?
Ryan Lee
Design Engineer
If you can think it it can be modeled
RE: NX 6.0 to 8.5
Anyway, I hope this helps explain why this is considered to be a 'big issue' and why you will be well served if you do a full 'refile' at this time.
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: NX 6.0 to 8.5
Ryan Lee
Design Engineer
If you can think it it can be modeled
RE: NX 6.0 to 8.5
The issue is that the Assembly has two Components, the 'valve body' and 'cover plate' which are NX 6.0 non-refiled parts while the rest of the Components in the assembly have been refiled into at least NX 7.5. This is what I mean when I said that the older non-legacy parts are 'ignored' when the Drawing views are rendered.
Note that if you do have assemblies with non-refiled components in them, when you try adding a view to a drawing the system does warn you of this fact as shown below:
And if you select the 'Details' button you'll get a report lookin something like this:
So you see, while we hope that you do perform a 'refile' we do supply tools to help you detect and correct issues which might arise if you didn't get everything covered all at once. Which I guess goes to your question about moving to NX 8.5 but delaying the refiling of the NX 6.0 archives, now that you're aware of some of the issues it's really up to you as to whether they will be show-stoppers or something that you can temporarily live with.
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:
To an Engineer, the glass is twice as big as it needs to be.
RE: NX 6.0 to 8.5
But, we ran simple performance tests opening large assemblies ( there is a timing figure in the NX logfile)
Then made sure all components were fully loaded and File- Save ( Since all components are version-upgraded, all components are modified, all become saved.)
Then started a new session and opened the same assembly again.
The load time noted made us take the decision to run "refile". ( UGmanager_refile_program if one runs Teamcenter.)
Regards,
Tomas
RE: NX 6.0 to 8.5
your old drawings will not honour the <W@$SH_MASTER_PART_NAME> unless you delete the flat pattern as re-do it